configurations and part numbers
configurations and part numbers
(OP)
As far as I know the is no way to assign a configuration a part number that the BOM part number field AND a drawing's title block can link to. I can go to Configuration Properties and select User Specified Name from the pull down menu and enter a part number in the "Part number displayed when used in a bill of materials" field, but I can't link my drawing border to this part number. At my company we typically enter the part number as the part's Title property (Properties > Summary > Title), which a drawing title block can link to ("SW-Title"), but there is no way to assign a title to a configuration. Our workaround so far has been to use the base part feature. That is, we make one part (the base part) with many configurations and then make many new derived parts, each referencing a configuration of the Base Part. This is a cumbersome solution, and the derived parts leave out cosmetic threads. Any suggestions? Anyone know if this problem will be solved in 2003? I am currently using SW2001+ SP5.1.






RE: configurations and part numbers
- The parts have a 10 digit code. Example: part 1234667800
The last two digits are for variants (the basic shape and manufacturing process is the same but the parts have some differences).
- Each of variants are designed as configurations of the base part. The name of each configuration is the code itself. Example: configuration 1234567801, 1234567802, 1234567803...
- The part file is saved with file name 12345678XX.sldprt
- I have some custom properties, for each configuration,and one of them is the part CODE. This CODE as the same value as the configuration name it refers.
- Then I make a drawing for each configuration. The sheet format calls the property $PRPSHEET{CODE} (the name must be the same as the custom property). This way the sheet format returns the value of the configuration you selected to draw (in fact, I call other custom properties like weigth, area, revision number,... and the sheet format allways returns the values of the selected configuration)
- The drawings are saved with file names equal to the configuration names: 1234567801.slddrw, 1234567802.slddrw,...
The drawing 1234567855.slddrw is the drawing of the configuration name 1234567855 of the part 12345678XX.sldprt
Hope that this can help you
RE: configurations and part numbers
RE: configurations and part numbers
I handle multiple configurations of parts in this manner. I created a custom file property called PART_NUMBER which is added to each configuration. I name each configuration with the desired part number and then add additional information in parenthesis.
12345 (material)
12346 (material, feature)
12347 (material, feature, feature)
This allows me to easily identify the desired configuration to display in an assembly or drawing.
Hope this helps.
RE: configurations and part numbers
You can Download it at: http://www.3dmca.com/Design_Portfolio/Custom_Bom.zip
I hope this is what your looking for.
Best Regards and good luck,
Scott Baugh, CSWP

credence69@REMOVEhotmail.com
http://www.3dmca.com
http://home.insightbb.com/~scott.baugh/
*When in doubt always check the help*
RE: configurations and part numbers