×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?
2

THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
I got this error in my simulation:
"THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS"

I tried looking at the manual , but couldn't figured out how to overcome this problem.


Any suggestions?

Thanks in advance

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

Hi Mohcine,

You are probably using continuum solid elements (C3D8R) with solid sections. To use the composite failure criteria in Abaqus, you must use continuum shell elements (SC8R) with shell sections.

Hope this helps

Firehole Composites
www.firehole.com

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
Thank you , that solved the problem.

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
When I modeled the composite as a shell, I get distortion errors and the job is aborted.
When I use 3D solid continnuum element, no distortion takes place and the jobs runs until the it is completed.

This happened as I was making the mesh finer. Any Ideas?

Thanks

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

Hi Mohcine,

Are you modeling progressive damage using the Hashin failure criterion? Do you have nonlinear geometry turned on (NLGEOM=YES) in *STEP card? Both of these things could be causing element distortion errors. You may not be seeing it for 3D solids because you are not modeling damage...?

Regards,

Firehole Composites
www.firehole.com

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
Yes am eventually modelling progressive damage...But for now , I removed the damage parameter from the composite material and the cohesive interaction t speed up the simulation i'm carrying out mesh study. When I use solid element , no errors encountered, however, when I use shell element (which seems to allow the usage of fail stress) error occurs and results in the job being aborted (for very fine mesh) :

Excessive incremental rotation of the elements in element set ErrElemExcessIncrementalRotation-Step1.

There is only one element with excessive rotations


The NLGEOM is always on :). I have included a picture of the last frame before the analysis is aborted.

My wild guess is that as the mesh is made finer, the contact force increases hence more distortion.

Thanks for your help :)

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

Didn't know you were using Explicit. Sorry but I am unfamiliar with Explicit and the errors associated with it.

Firehole Composites
www.firehole.com

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
I see :(...many thanks for your commendable intention to help me :). Words can not express my gratitude.

I love your blog by the way, It has something informative, easy to follow posts.

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

I am not sure if this is going to be any help but here are my two cents:

Node on structural elements such as shell elements not only have translational but also rotational degrees of freedom. If you do not restrain DOFs appropriately, you'll end up encountering unexpected issues.

http://www.eng-tips.com/faqs.cfm?fid=376
http://www.eng-tips.com/faqs.cfm?fid=1083

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
I applied encastre boundary conditions at all the four edges...But I will change the those conditions and see if that helps. Thanks for the suggestion :). I might also try using kinematic instead of penalty for the contact constrain and see if it helps.

Thanks again

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

I must qualify my previous statements. This DOF business that I've been going on about is applicable only to conventional shells and not continuum shells. Nodes on continuum shells have translational DOFs only. If you have not, try to use conventional shells for your analysis (but make sure thickness change is "small"; see "Stress/displacement continuum shell elements" in the Analysis User's Manual for details.) They are more suitable for nonlinear geometric analysis. However, I recommend going through the "Choosing a shell element" section of the Analysis User's Manual before you start experimenting.

http://www.eng-tips.com/faqs.cfm?fid=376
http://www.eng-tips.com/faqs.cfm?fid=1083

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
That sounds like a good idea..I will try it and report back when I have. Is there an easy way to convert a contiuum shell to conventional shell? As i did for solid to shell?

Apologies for the late reply, my laptop broke and i had no means of replying.

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
I have used conventional shell (2D) and didn't encounter any problem as I previously did.

I have wanted to make that clear, just in case some else in future experiences similar error.

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

(OP)
@compositesFEAguru I would like to get in contact please :). I wish to mention you in my acknowledgement, for helping me alot.
Thanks

RE: THE *FAIL STRESS OPTION CAN ONLY BE USED WITH PLANE STRESS ELEMENTS?

@Mohcine - You can connect with me on LinkedIn by clicking on the link on the right side of our blog (http://info.firehole.com/blog).

You are most welcome!

Firehole Composites
www.firehole.com

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources