×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Flatness vs. Parallelism

Flatness vs. Parallelism

Flatness vs. Parallelism

(OP)
Hi,

I would like to know if there is principle of tolerance or dependence between Flatness and Parallelism ?

for example:

cube with [datum A flatness 0.02 (mm)] on its one face
and on the parallel face tolerance of [parallelism 0.02 (mm) to datum A]

the value of parallelism tolerance should be bigger or smaller than flatness ?

Thanks

RE: Flatness vs. Parallelism

"the value of parallelism tolerance should be bigger or smaller than flatness ?"

Assuming you mean bigger or smaller relative to the flatness of datum A surface, I think it can be either, depending on what you need. You could also call a value for each , for example, parallel .04 A, flat .01.

RE: Flatness vs. Parallelism

When parallelism is applied to a surface, the tolerance zone is two parallel planes which are parallel to the datum, all elements of the tolerance surface must be within the tolerance zone, the flatness of the surface is also controlled within the parallelism tolerance zone.

SeasonLee

RE: Flatness vs. Parallelism

koooala,
From your descripition it seems that you need to know whether there is any Flatness / Parallelism relationship when those two characteristics are applied to different features. If that is the case, the answer is NO there is no such relationship, however...

If you imagine your cube having a linear dimension specified between the two sides, then the values of these geometrical callouts will be dependent on dimension (size) tolerance. That being said, if the dimension was 10+/-0.01 (i.e. 0.02 tolerance), both values you gave would be acceptable, but could never be greater than 0.02. This is assuming you work to Y14.5 when envelope principle is default rule for tolerancing.

RE: Flatness vs. Parallelism

(OP)
CheckerHater:" It's kinda like this: ->

http://files.engineering.com/getfile.aspx?folder=e...
"

It is exactly what I had in my mind.

Does every body agree with this picture ?

summary the picture:
1. Parallelism tol shouldn't be a smaller than Flatness tol
2. Size tol shouldn't be a smaller than Parallelism tol

What should be the recommended proportion of this values ?
i.e Size Tol = (Flatness Tol)/10
or Size Tol >= Flatness Tol
or Size Tol >> Flatness Tol

or Parallelism Tol >= (Flatness Tol)/2

Thanks

RE: Flatness vs. Parallelism

Generally speaking, I don't see any point in a geometric tolerance that is greater than half the size tolerance. Beyond that it just comes down to what you need. There are no hard and fast rules.

----------------------------------------

The Help for this program was created in Windows Help format, which depends on a feature that isn't included in this version of Windows.

RE: Flatness vs. Parallelism

koooala.

There is no rule chiseled in stone, but you may consider the following ratios between size tolerance and associated form tolerance (flatness or straightness) in relation to level of precision:

Normal (or “standard” or “medium”): 60%
Enhanced (or “reduced tolerance”, or “fine”): 40%
High (or “precision” or “extra fine”): 25%

Once again, it’s not a standard, just a general guidance.

RE: Flatness vs. Parallelism

Hmm, I'd be very careful using rules of thumb for this.

We make precision equipment which for several reasons often need very good flatness and/or parallelism.

It's not unusual for us to have parts with say +-.010 size tolerance on a dimension but with flatness of under .0005 and parallelism of around .001 or similar.

I'd say this is a case where it really should be driven by functional requirements.

Posting guidelines FAQ731-376: Eng-Tips.com Forum Policies http://eng-tips.com/market.cfm? (probably not aimed specifically at you)
What is Engineering anyway: FAQ1088-1484: In layman terms, what is "engineering"?

RE: Flatness vs. Parallelism

Kenat,

I was just trying to illustrate what could be considered “normal” and what “precise” from average shop point of view, not “your flatness should always be ¼ of your size tolerance”.
You said it yourself: “We make precision equipment”; so I assume sometimes special considerations are taken to achieve required flatness, etc.

Could we add “or less” after my numbers, pleeease?

RE: Flatness vs. Parallelism

CH,
I always wondered if there might be some kind of rule of thumb for this kind of thing. I do understand it is not a hard rule!
I am curious where it come from, I always thought it might make sense to be like 1/3 of the total size (rule of Frank);]

RE: Flatness vs. Parallelism

Ken,
I agree, I am just interested in the subject and functional requirements are not always so clear cut.
I think this is also a "machined features" type of thing, CH, correct?

RE: Flatness vs. Parallelism

Frank,

This is from the book printed long ago and far away. There is small possibility to find old ISO standard on this topic.

And I agree: sometimes “fairly flat machined surface” IS functional requirement smile

RE: Flatness vs. Parallelism

I agree that the values for straightness or flatness tolerances shall be chosen based on functional analysis, however in order to pick appropriate values one must understand how accurate a manufacturing process is - in other words, which values are realistic and achievable, and which are not.

This is what ISO 2786-2:1989 says about general flatness and straightness tolerances for machined part. Interesting is the fact that the values are not dependent on the thickness of the feature but on its length. Another interesting thing is that those values are named as corresponding to "customary workshop accuracy".

http://files.engineering.com/getfile.aspx?folder=6...

RE: Flatness vs. Parallelism

The flatness or parallelism geometric tolerance must always be a refinement of the general tolerance of size. So it makes no sense for it to be equal or nearly equal to the size tolerance. That is why I said as a general rule is should be about half or LESS. It can be as small as you need it to be. I've got flatness tolerances that are less than 1% of the size tolerance where a part has to be really flat. It takes some specialized manufacturing to do it.

----------------------------------------

The Help for this program was created in Windows Help format, which depends on a feature that isn't included in this version of Windows.

RE: Flatness vs. Parallelism

I'd lean toward what dgallup is saying.

If envelope principle is in play then your flatness/parallelism tolerance at worst case = you size tolerance. Now in practice you're going to get significantly less than this in most cases as it needs to cover both flatness, parallelism and other surface deviations.

Hence if you need a separate flatness/parallelism tolerance beyond what you get from envelope principle then it generally makes sense that it's going to be less than around half your size tolerance.

Pmarc, while manufacturability is important, it should be secondary to function. You need to make sure what you functionally neeed can be made cost effectively.

However, just because flatter than you need is typical of the anticipated manufacturing process, I'd be loathed to specify a tighter flatness than I actually need. Processes change, small errors get made... so I'd leave my flatness as loose as functionally permissible.



Posting guidelines FAQ731-376: Eng-Tips.com Forum Policies http://eng-tips.com/market.cfm? (probably not aimed specifically at you)
What is Engineering anyway: FAQ1088-1484: In layman terms, what is "engineering"?

RE: Flatness vs. Parallelism

Kenat - that's twice you've agreed with me today. Either you're getting soft or my posting is improving.thumbsup2

----------------------------------------

The Help for this program was created in Windows Help format, which depends on a feature that isn't included in this version of Windows.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources