Is there a way to combine multiple holes in the same location into a single hole callout instead of multiple callouts all pointing to the same location? Thanks.

If you are talking about something like "3X blah, blah, blah" you get this automatically if you use the Hole Wizard and create multiple points for the holes. This is often times much nicer than creating one hole and then patterning it.

- - -Updraft

Thank you for the response.

However, I am referring to
a
drill xxx xxx deep
b
drill xxx xxx deep
c
drill xxx xxx deep
tap xxx xxx deep

where they are different diameter and depths but at the same place.

Please post an example part or screenshot.

If I'm understanding what you're asking for, then the answer is no. At least not automatically. I suppose someone better versed in macros could create a macro to do what you want, but SolidWorks won't do it out of the box.
Assuming you are using the hole wizard, it will only create one type of hole per feature, though multiple instances. It's this hard-coded information that the hole callout tool uses in drawings and it will only call out one hole 'group' at a time. Also, you're selecting the edge of a hole and, in your example, they'd have smaller diameters for each hole so they wouldn't be sharing an edge.

Jeff Mirisola
Director of Engineering
M9 Defense
My Blog

That is true, but the center point is the same. It would be nice if you could click on the center point and have it combine all the hole notes for the same hole or have the option of doing it separately for each diameter.

A compound or multi-feature hole. As described by others, Solidworks can only autodimension single hole features or hole wizard holes using the default text in the supplied text file.

While not an ideal solution, you can force-fake it and keep it parametric:

Dimension all hole features, put these dimensions on a separate layer and change the color and remember to turn the layer off prior to printing. Make a leader note pointing to your compound hole and just hyperlink to all the individual dimensions text. Format as required with line breaks, additional manual text, etc.

Quote (jfoxx)

Thank you for the response.

However, I am referring to...

I think you should use a section view. Even on a drafting board, could you write an unambiguous description of your hole?

--
JHG

You can do this, but there is a little bit of set up.

Insert all the callouts you'll need on your drawing.

Start an annotation note. While editing the annotation note, click on your callouts in the order you wish them to appear in your final callout. As you click on them, they will populate your annotation note.

Once you are done, accept your edits in the note. Then, hide all the individual callouts.

Matt Lorono, CSWP
Product Definition Specialist, DS SolidWorks Corp
Personal sites:
Lorono's SolidWorks Resources & SolidWorks Legion

Interesting, Matt. Very simple & clean workaround.

Is there a reason for suggesting to only hiding the callouts, rather than deleting them?

CBL,
I suspect that if you delete the callout the note won't update should you change one of the holes.

Jeff Mirisola
Director of Engineering
M9 Defense
My Blog