×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Preloading a spring element

Preloading a spring element

Preloading a spring element

(OP)
Hi,

I am trying to use a spring element to idealise a bolt in a dynamic (eigenvalue & harmonic) analysis. I read all the associated literature on calculating equivalent spring stiffness to represent a bolt. Now I wonder how can I give preloading to a spring element?

Commercial FEA software have well developed pre-tension elements or some recommend good old method of applying temperature to create preload. But I want to use spring elements due to their simplicity in usage.

One possibility to apply preload in spring seems to be moving, in initial load step, one of the bolted structures by some displacement equivalent to (preload force / spring stiffness). Then perform all subsequent frequency extraction, etc. This would amount to tensioning (stretching) the bolt by preload amount. Is this correct ? Any other suggestions ?

Thank you.

Geoff

RE: Preloading a spring element

(OP)
Clarification:

What I meant in my previous post is, in the initial load step, to push both the bolted plates together while connecting spring element onto the outer nodes of plates. This creates compression in bolted plates and tension in spring element. I would like to know if this is correct.

Thanks, Geoff

RE: Preloading a spring element

Not sure which code you're using, but I've quickly looked at the COMBIN14 spring in the ANSYS manual, and the user can apply a preload to this element in a couple of ways.

"A preload in the spring may be specified in one of two ways, either through an initial (force-free) length (ILENGTH) or an initial force (IFORCE) input. Only 2-D or 3-D springs support this input (KEYOPT(2) = 0). Only one of the input options may be used to define the preload. If the initial length is different than the input length defined by the nodal coordinates, a preload is presumed to exist. If an initial force is given, a negative value indicates the spring is initially in compression and a positive value indicates tension. "


------------
See FAQ569-1083: Asking questions the smart way on Eng-Tips fora for details on how to make best use of Eng-Tips.com

RE: Preloading a spring element

(OP)
Hi Drej,

Many thanks for your mail.

I am using Abaqus in which there are only three types of Spring elements - Spring1, Spring2 and SpringA. Basically they differ in the connection direction and nodes. For e.g. Spring1 connects a node and ground, Spring2 connects two nodes. And finally SpringA acts along a line of action instead of a fixed direction like Z-axis, etc.

I wonder if it is available in Ansys, it must be there in some form in Abaqus as this is a very simple element.

If you know something on this, please update. I will also check on this.

Thank you for your help.

Regards
Geoff

RE: Preloading a spring element

(OP)
Drej,

One issue with ANSYS COMBIN14 element is ambiguity in their definition of damping coefficient.

Here is what it says in Element library:

The damping portion of the element contributes only damping coefficients to the structural damping matrix. The damping force (F) or torque (T) is computed as:
Fx = - cvdux/dt or Tθ = - cvd θ/dt 

They say damping coefficient adds to structural damping matrix (which means damping force should be proportional to displacement) and then gives the formula showing proportionality to velocity (which shows it like a viscous damping coefficient). I am not sure what it does actually. Any idea what this means?

Generally structural damping is good to simulate bolts.

Thank you

Geoff

RE: Preloading a spring element

I suggest you check this on a simple model, but preload should make no difference to the frequencies you obtain in a linear analysis.

That's because preload is a non linear phenomenon

Cheers

Greg Locock


New here? Try reading these, they might help FAQ731-376: Eng-Tips.com Forum Policies http://eng-tips.com/market.cfm?

RE: Preloading a spring element

Just a note that preload may make some difference, since you can carry out a pre-stressed modal analysis which locks in the stiffening from a previous analysis. In ANSYS, use the PSTRES command and ANTYPE,STATIC prior to a modal analysis to achieve this.


------------
See FAQ569-1083: Asking questions the smart way on Eng-Tips fora for details on how to make best use of Eng-Tips.com

RE: Preloading a spring element

(OP)
Hi Drej, Greg,

Thank you for your response. I searched all possible literature on ANSYS and found that the COMBIN14/7/37/40 elements take only viscous damping coefficient. For a detailed review of various damping types and their specification in ANSYS, I found the attached document very useful. Hope anyone visiting this thread may find it useful.

As mentioned in the attached file, there is one alternative by specifying betaj parameter for different materials (but not for elements defined without geometry, such as a spring element).

Summary - in ABAQUS for a spring element we can give either viscous or structural damping, but cannot give preload; in ANSYS we can give preload to spring but can only specify viscous damping not structural damping.

Regards
Geoff

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources