×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Feed slowdown in corners with radius

Feed slowdown in corners with radius

Feed slowdown in corners with radius

(OP)
Hello,

I have a problem with Hi feed cutter. I am milling a part with rounded corners with a feed of 9000mm/min. The problem is that i get the corners radius much bigger than should be, because the cutter is not slowing down in corners. I can do a slowdown in a sharp corner with "Feed slowdown in corners" but not where there is a rounded corner (for example R1.)

Is there any possibility that I do this in Siemens NX8.

Thank you.

RE: Feed slowdown in corners with radius

(OP)
I made some mistakes in upper post. First of all I need to slowdown feed in arc not in corner. And second, I cannot do it with sharp arc. I can only speed it up. Is there any possibility to slow down  feed in arc?

Thank you.

RE: Feed slowdown in corners with radius

Hello Voran,
I have not used NX8 yet, but I hope its the same as NX3, NX4, and NX6 (using now).  You should find it under "cutting parameters" and then "corners".  You will need to change the options under the "Feed Slowdown in Corners" tab.  The other tab "Feed Adjust on Arcs" seems misleading to me, as I can never get it to do anything.  

Anyway, you need to change the follow options:

Slowdown Distance = Current Tool
Tool Diameter Percent = 100 (or 110)
Slowdown percent = 10
Number of steps = set to how many feed changes you want, I just use 1
Minimum Corner Angle = 0
Maximum Corner Angle = 175 (or 179)

The output for my radius cut looks like this (notice it slowing down to 13, or 10% of 127, in the radius):
N120 G0  X14.153 Y-17.499 A-90.000 C0.000
N121 Z49.000
N122 Z5.218
N123 X14.153 Y-17.499
N124 G40 G1  X8.438 F  127
N125 X4.807 F   13
N126 X7.483 Y-15.254
N127 X10.671 Y-12.578 F  127
N128 Z105.218
N129 G0  Z49.000
N130 X14.153 Y-17.499
N131 Z3.245
N132 X14.153 Y-17.499
N133 G1  X8.438

Hope this helps.

UG NX3/NX4/NX6
Vericut 5/6/7
AutoCAD LT

RE: Feed slowdown in corners with radius

There is also Optimize Feed Rate which you may want to check out. I have pasted some of the documentation.

Optimize Feed Rate

Use the Optimize Feed Rate option to remove material more efficiently and to extend tool life. This option constantly monitors tool load and adjusts the feed rate to maintain a uniform tool load.

The software uses a 3D IPW model or blank geometry to calculate the feed rates.

You can:

Optimize the feed rate every time NX generates the operation’s tool path with the Optimize Feed Rate When Generating option.

Optimize the feed rate for a previously generated operation from the Operation Navigator.

Add the Optimize Feed column to the Operation Navigator to see which operations have optimized feed rates.


NX 7.5

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources