NX7.5 - SHOW LIGHTWEIGHT ?
NX7.5 - SHOW LIGHTWEIGHT ?
(OP)
What's the scope of this 'show lightweight' function, is that visual representation of components saved with the part/assembly or is it just a session setting?
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NX7.5 - SHOW LIGHTWEIGHT ?
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RE: NX7.5 - SHOW LIGHTWEIGHT ?
What is it?
Lightweight loading is no longer controlled by reference set. New controls determine whether components are loaded lightweight (using faceted representations) or exact (using solid representations).
Set the Use Lightweight Representations assembly load option to specify which representation is used when a component is loaded. You should also set the Use Partial Loading assembly load option to fully realize the performance and memory benefits.
Use the Show Exact and Show Lightweight commands to switch between representation types.
Because lightweight loading is now separate from reference sets, you can load any reference set lightweight, as long as lightweight representations exist for the contents of the reference set. For example, you can load the Entire Part reference set lightweight if the representations exist.
Use the Automatic Lightweight Generation customer default to control whether NX maintains lightweight representations for all bodies or just those belonging to certain reference sets.
Because the lightweight reference set is no longer needed, it is automatically removed from your parts:
NX does not retain the lightweight reference set except for some cases where you edited the contents for special use. You can ensure that the lightweight reference set is always deleted by setting the Lightweight Reference Set Removal customer default to Remove All.
When you use the As Saved assembly load option to load a component whose last-used reference set is a Lightweight reference set that is being deleted, the Model reference set is loaded instead. The representation used depends on the Use Lightweight Representations assembly load option.
Why should I use it?
Loading assemblies using lightweight representations instead of exact representations can provide significant memory savings and improved load and display performance, especially when you work in large assemblies.
The new lightweight loading controls make it easier for you to load your assembly lightweight using the reference sets of your choice.
Best regards,
Michaël.
NX7.5.4.4 + TC Unified 8.3
Win 7 64 bit
RE: NX7.5 - SHOW LIGHTWEIGHT ?
Anyway, I hope this helps explain how this new approach will benefit you and help to improve your working efficiency.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
UG/NX Museum: http://www.plmworld.org/p/cm/ld/fid=209
To an Engineer, the glass is twice as big as it needs to be.