Merge faces into one FACE? Is it possible?
Merge faces into one FACE? Is it possible?
(OP)
I'm trying to measure wetted area distribution of a sheet body consisting of hundreds of faces.
for this:
1. sheet body is trimmed by a plane (say, x=0).
2. area of trimmed body is measured.
3. plane is moved, say +1" (x=1)
4. GOTO 2.
currently this is done tediously by hand, and not automated with "goal analysis" due to the following
PROBLEM: face measurement feature is not updating, as some of the faces of measured body appear (or disappear if trimming out the other side)
So, hence the
QUESTION: is it possible to make face measurement feature update properly?
OR: combine faces into one FACE. (ICEM, i know, is capable of this)
PS. Geometry is too complex to slice is along and accross to put surface mesh on it...
THANKS!
for this:
1. sheet body is trimmed by a plane (say, x=0).
2. area of trimmed body is measured.
3. plane is moved, say +1" (x=1)
4. GOTO 2.
currently this is done tediously by hand, and not automated with "goal analysis" due to the following
PROBLEM: face measurement feature is not updating, as some of the faces of measured body appear (or disappear if trimming out the other side)
So, hence the
QUESTION: is it possible to make face measurement feature update properly?
OR: combine faces into one FACE. (ICEM, i know, is capable of this)
PS. Geometry is too complex to slice is along and accross to put surface mesh on it...
THANKS!





RE: Merge faces into one FACE? Is it possible?
RE: Merge faces into one FACE? Is it possible?
RE: Merge faces into one FACE? Is it possible?
But it doesn't work. (I use "Convert to B-Surface")
for almost every face (90%-95%)comprising the sheet body I get is
"face is not parametrical-rectangular"
I see this menu item is abcent in NX8.0.
May be they came up with something better?
RE: Merge faces into one FACE? Is it possible?
Insert -> Trim -> Delete Edge.
But this tool doesn't even give the error. It simply doesn't select any internal edges.
RE: Merge faces into one FACE? Is it possible?
RE: Merge faces into one FACE? Is it possible?
RE: Merge faces into one FACE? Is it possible?
I'll prepare an example file.
RE: Merge faces into one FACE? Is it possible?
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
UG/NX Museum: http://www.plmworld.org/p/cm/ld/fid=209
To an Engineer, the glass is twice as big as it needs to be.
RE: Merge faces into one FACE? Is it possible?
Here I prepared a simplified example (NX6.0) of a nozzle with a centerbody. I put a couple patches on the outer surface. In reality the whole surfaces is made of patches. It would also have surfaces of pylons connecting outer and inner surfaces, fillets and other details.
http://www.cap-ny153.org/Nacelle%20Diagram.jpg
The example goal is to measure wetted area distribution of the outer surface of the nozzle with centerbody.
For this a plane is trimming the body. Then area measurement is made and repeated after each surface shift. Along with other measurements of flow area and others it can provide good estimate of losses in the nozzle. And could be used as part of design optimization, sensitivity analysis and other.
using goal analysis in the embedded sheet would significantly speed up the analysis. Unfortunately, area measurement fails (does not update ) once a face in the set of measured faces disappears as it get trimmed away (why not to measure it as 0in² and move on?) And it definitely does not start including new faces as I move plane forward. (why not allow measuring surface a BODY, not only separate faces?)
you can see on the chart the failure point is position of the plane when purple patch is trimmed away completely
So I thought the solution would be is to merge somehow all the faces into one. But UG, compared to ICEM, has very limited capabilities of that (Insert -> trim -> join) as I described in the post yesterday.
THANKS!
P.S. if you disable trim body feature, enable trim feature and move trimming plane around, you'll see that the portion trimmed away is changing from left to right. A problem somewhat similar to what I was describing in http://www.eng-tips.com/viewthread.cfm?qid=285907 but couldn't create a example for.
RE: Merge faces into one FACE? Is it possible?
should be "after each plane shift" sorry
RE: Merge faces into one FACE? Is it possible?
You imply that you have to select faces one at a time. If you're using the...
Analysis -> Measure Face...
...function, have you looked at the 'Selection Intent' options when you selected the faces? After all, there are several options including 'Body Faces'.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
UG/NX Museum: http://www.plmworld.org/p/cm/ld/fid=209
To an Engineer, the glass is twice as big as it needs to be.
RE: Merge faces into one FACE? Is it possible?
I tried out different selection intent options, but no matter what was used the measure face feature became unassociative and gave incorrect results when one or more of the faces were cut off completely by the datum plane.
www.nxjournaling.com
RE: Merge faces into one FACE? Is it possible?
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
UG/NX Museum: http://www.plmworld.org/p/cm/ld/fid=209
To an Engineer, the glass is twice as big as it needs to be.
RE: Merge faces into one FACE? Is it possible?
www.nxjournaling.com
RE: Merge faces into one FACE? Is it possible?
yes. It seems selection intent is part of the GUI and is not preserved in the feature.
trim sheet feature is even more puzzling: when a surface defining flow area (a cone trimmed by the multi-patched duct) is moved along the duct (to measure area distribution along the nozzle) the timmed\retained regions swap several times. For that I end up using trim body, with significant overhead of trimming all patches to sew into one sheet body.
this example though gave me an idea: it seems the trim sheet feature stores which face of the body was selected for trim sheet feature. May be cutting out a tiny piece in the middle of the flow area sheet, patching it, and selecting a patch would make trim sheet feature robust. I won't blame you, if you call it way distorted.
the .jpg intent was to illustrate one of the applications.
Thanks
RE: Merge faces into one FACE? Is it possible?
It might be possible to merge into a "polygon face" which what is what NX CAE is using for FEM meshing. Those faces have the ability to delete edges etc.
Maybe, ( i dont know) you can measure the area there.
RE: Merge faces into one FACE? Is it possible?
NX8 crashes when exporting real geometry into the polygon file, but survives the example. However, how do I import the polygon file? Don't see options in Open or Import
Thanks
RE: Merge faces into one FACE? Is it possible?
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
UG/NX Museum: http://www.plmworld.org/p/cm/ld/fid=209
To an Engineer, the glass is twice as big as it needs to be.
RE: Merge faces into one FACE? Is it possible?
RE: Merge faces into one FACE? Is it possible?
It seems they beat me to the punch as this issue was already being addressed.
Starting with the next version of NX (not NX 8.0, but the next one, which we start beta-testing in April), when performing Edge, Face and Body measurements, the 'Selection Intent' option used will be retained with the measurement feature and will be reapplied when the model is updated and the measurement is recomputed.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
UG/NX Museum: http://www.plmworld.org/p/cm/ld/fid=209
To an Engineer, the glass is twice as big as it needs to be.
RE: Merge faces into one FACE? Is it possible?
I just installed the latest development phase of the new release, where this issue was resolved, and tested it on your simplified example and it worked perfect.
The only caveat is that you will have to delete the old Face Measurement features and create new ones as the old ones will NOT automatically morph into something which now behaves as you has originally expected it to. Now the old Face Measurement features will still update and give the same results as before, but it will still exhibit the old behavior and limitations. However, if it was working OK for you prior to the changes it will still be OK after words.
John R. Baker, P.E.
Product 'Evangelist'
Product Engineering Software
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
UG/NX Museum: http://www.plmworld.org/p/cm/ld/fid=209
To an Engineer, the glass is twice as big as it needs to be.