×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Tool Retract Path

Tool Retract Path

Tool Retract Path

(OP)
The tooling I use is Ø8" (grinding wheels) and after I make a grind path, the grinder combines X, Y and Z to go to the next path. The problem is with such a large tool bit, the wheel will hit fixtures ect. I've tried to add more retract but the grinder can only retract in one direction just so far. I need to have my rapid/ transfer go in direction X for a distance then go in Y for a distance ect. Is there an option for this?

NX7.5

Thanks.

RE: Tool Retract Path

The only option I can think of is for you to program the clearance points into your toolpath where you want them.

You also need to understand how the machine tool treats a rapid command when XYZ values are in the same line. On feed in, most do the XY, then the Z. On retract, they do the Z move, then the XY. You may be able to use the NX Home point in your program as an internediate point.
 

"Wildfires are dangerous, hard to control, and economically catastrophic."

Ben Loosli

RE: Tool Retract Path

(OP)
Thanks looslib,

I worked with a clearance point but the path went straight to it. I need up first, over second ect.
It might be something in the grinder itself??

RE: Tool Retract Path

You can probably modify the post so that it outputs the individual axis on separate lines:

Clearance point = x : 12.00 , y : 6:00 , z: 10.00

Posted output:

G0 Z10.
X12.
Y6.
 

NX 7.5.4.4, NX 8.0(Evaluating)
Tecnomatix Quality 8.0.1.3

RE: Tool Retract Path

A brute force option might be to put a basic retract in the milling operation with out a move to the clearance, and then insert a Generic Motion operation imediately after, that will take the tool along whatever path you need.  

Mark Rief
Product Manager
Siemens PLM

RE: Tool Retract Path

I do this type of thing all the time. Getting long tools safetly into parts on a 5-axis machine sometimes requires some fancy moves.

There is no "neat and tidy" way to do it. It takes some planning.

The way I approach it is with "GOTO" points in the start and end events of each tool path.

you can make the tool dance around anywhere you like however, the points will not update if you change something. You need to keep track of them yourself.

Alternately, if I am going to be repeating the same "retract" move after every toolpath, sometimes I will create a machine control event(operation) containing the moves and copy and past as required.

J

NX 6.0.5.3

RE: Tool Retract Path

I will sometimes use a fixed or variable contour operation using points as the drive method to create an approach or departure path to get the tool to or away from the part.  This way it stays associative to the points if I need to move them later.

John Joyce
N.C. Programming Supervisor
Barnes Aerospace, Windsor CT
NX6.0.5.3

RE: Tool Retract Path

One advantage of Generic Motion is that you can make the points and vectors associative, if you select geometry when you define them. Even if you offset from those points, they will remain associative. If you drag the dynamic handles to get the points and vectors, then they are not associative.
 

Mark Rief
Product Manager
Siemens PLM

RE: Tool Retract Path

(OP)
Thank you all!!

I need to get some time to start trying these ideas. Maybe in another few days.

Thanks again.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources