Balloon help
Balloon help
(OP)
Really struggling in UG drafting. Placed parts list and autoballooned the drawing. Now I'd like to;
- Create multiple attachment points for the same balloon in one view
- Create additional same numbered balloons in different views.
I'd like everything to be associative if possible. Can't even find a command to create a dumb balloon.
Searching the UG help for "balloon" brought back very little info.
NX6
Thanks...
- Create multiple attachment points for the same balloon in one view
- Create additional same numbered balloons in different views.
I'd like everything to be associative if possible. Can't even find a command to create a dumb balloon.
Searching the UG help for "balloon" brought back very little info.
NX6
Thanks...
--
Fighter Pilot
Manufacturing Engineer





RE: Balloon help
Note that there's no practical way to add a second Leader to an existing ID Symbol (AKA 'Balloon') other than placing a second one over the top of the first one.
As for adding additional ID Symbols in another view, just go to...
Insert -> Symbols -> Identification Symbols...
...and using the same Type of Symbol as was generated by the Parts List, create as many additional 'Balloons' as needed making sure that the Leader Line is attached to the desired Components. Once you're finished, select the Parts List note, press MB3, select 'Update Parts List' and all of the manually created 'Balloons' will update so that they have the proper ID callout in them.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Balloon help
There is no ID Symbol under Insert > Symbol.
Also, it seems like it will let me reattach a balloon (ID Symbol) to a component that is not the one called out in the parts list. Is that the case.
--
Fighter Pilot
Manufacturing Engineer
RE: Balloon help
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Balloon help
So do I just type in the same number as the balloon I want? If so that's not very parametric is it? Will it update if I add/delete/re-sort the table?
--
Fighter Pilot
Manufacturing Engineer
RE: Balloon help
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Balloon help
As much as I hate it, that is part of the work flow here. "Real" parts lists are hopefully going to be phased in soon.
"Good to know you got shoes to wear when you find the floor." - Robert Hunter
RE: Balloon help
--
Fighter Pilot
Manufacturing Engineer
RE: Balloon help
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Balloon help
OMG this UG drafting package may be the biggest POS I've ever worked with. Something that should have been out the door weeks ago is still sitting on my screen. My kingdom to get back on Pro/E.
/end vent/
Per John's instructions above I can create the ID Symbol. The issue now is attaching it to the correct component so it will populate the item number. It LOOKS like I'm attaching to the component but I assume not because the balloon is not filling in with the number from the parts list. When I move the view it seems like the note just points into space. What is the trick to selecting 'the component'??
--
Fighter Pilot
Manufacturing Engineer
RE: Balloon help
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Balloon help
You must have the patience of a saint to put up with all the questions.
When I activate the command an orange circle appears so I just pick a point in my drawing view and then close. Then I double click the balloon and then pick Select Terminating Object. At this point I put my cursor over an edge of the component. Nothing appears in the que line. If I hold down LMB a circle with a line thru it appears.
BTW, I'm working in a full section view if that matters. I get the same behavior in a complete view too.
--
Fighter Pilot
Manufacturing Engineer
RE: Balloon help
Give it a shot and let me know how it works for you.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Balloon help
I have been fighting an issue for a couple of days with Widfire where the formats pulled in parameters from the model in WF3 but won't in WF4. No changes to the start parts or the format files.
A lot depends on which system you 'grew-up' on versus transitioned to. I started with UG in 1987 and Pro/E in 2001.
"Wildfires are dangerous, hard to control, and economically catastrophic."
Ben Loosli
RE: Balloon help
I'm sure both have the good/bad points. I'm sure the issues here really revolve around the lack of administration rather than the package itself. We typically do just MBD for the product design but the tooling group uses drawings still.
I knew Pro/E like the back of my hand simply because I wasn an admin as well as a user. I'll figure it out in time. I'm just now getting up to speed on the modeling aspects of UG NX.
JohnRBaker always seems to answer any questions I have. John, tried your suggestion this morning. Works perfectly. Thanks...
--
Fighter Pilot
Manufacturing Engineer
RE: Balloon help
Wayne Huseby
Drafting Checker
Goodrich Corp
Jamestown, ND 58401
RE: Balloon help
Are these new words learnt something a non-native English speaker should try learn or are they all proprietary
RE: Balloon help
Step 1: start a drafting application -> drop in base view of model.
Step 2: add id symbols to drawing view(tried many different shapes, circle, triangle, split circle, rounded box). Clicked on an edge of components, dragged empty symbol into drafting space, and dropped. Repeat until desired symbols are shown.
Step 3: Insert->Partslist. Dropped parts list onto drafting space. Right clicked onto partslist....update partslist.
Nothing happens. I have to imagine there is a setting somewhere in the annotation settings that is stopping this.
Autoballoon feature works just fine every time, but it doesnt work as described in the above posts.
Thanks,
Mat
RE: Balloon help
RE: Balloon help
Mat
RE: Balloon help
RE: Balloon help
RE: Balloon help
exactly as described by John R Baker, it could have been: part name, material, stock size.....whatever I needed for the particular drawing. Now for some stange reason this does't work anymore.....I'm using the same drawing template...Autoballoon works fine but places a callout for every part, something I don't need, and frankly I find organizing the Autoballon placement very tedious.....
I have tested this on another installation in the office with the same software release and everything works just fine.....at one point I thought the problem must lie with some customer default that I must have changed....so I cleared all values on my computer and tried again....but no joy.
I am now considering re-installing the software as I can't think of any other solution.
RE: Balloon help
UGII_UPDATE_ALL_ID_SYMBOLS_WITH_PLIST=1
Simplest way to do that:
Win XP: Windows Control Panel -> System -> Advanced (TAB) -> Environment Variables
or
Win 7: Windows Control Panel -> System -> Advanced System Settings (Upper left) -> Environment Variables
Create a new USER variable called:
UGII_UPDATE_ALL_ID_SYMBOLS_WITH_PLIST
set the value to
1
Now if you update the parts list, any ID symbol that has a leader from a component will update.
Anthony Galante

Senior Support Engineer
NX4.0.4MP10, NX5.0.0->5.0.6, NX6.0.0->NX6.0.5, NX7.0.0->NX7.0.1 & NX7.5.0.32-> NX7.5.4.4, Beta NX8.0.0.23