NX 5 Hole feature launches sketcher ???
NX 5 Hole feature launches sketcher ???
(OP)
On the newer versions of UG why in the world does the hole feature now launch sketcher? Is there anyway to keep this from happening. For the life of me I do not see how this is more user friendly or efficient than the NX2 version of the command.





RE: NX 5 Hole feature launches sketcher ???
Now that being said, since you have at your disposal ALL of the Snap Point options, you could have toggled ON the 'Point on Face' method, which will, to some extent, emmulate the pre-NX 5.0 behavior, EXCEPT that you will NOT be given the chance to define location dimensions, as that's what we intend that you use the Sketcher for.
And note that this is not a unique behavior nor even new behavior in NX. For example, when creating an Extrude or Revolve feature, if you have NO predefined profile or set of curve/edges suitable to be used in an Extrude/Revolve operation, you are automatically taken into the Sketcher where you can define a profile or network of curves suitable for Extruding/Revolving. This same approach is used throughout NX Sheet Metal and is being found in other workflows as well such as when creating Variational Sweeps and an Emboss feature.
This approach of defaulting to creating a Sketch when there was nothing appropriate to select, either as profiles or locations, is going to continue to be the norm for NX and will eventually be incorporated, where applicable, in other NX functions as they are updated and brought up to the new workflow and dialog standards.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 5 Hole feature launches sketcher ???
Developers sheesh!!! Thanks for your help.
RE: NX 5 Hole feature launches sketcher ???
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 5 Hole feature launches sketcher ???
"Good to know you got shoes to wear when you find the floor." - Robert Hunter
RE: NX 5 Hole feature launches sketcher ???
I put four holes located on each corner of a block with a horizontal and vertical dimensions of zero. The blocks lower left corner is a 0,0,0. Then I try to relocate them. Upper right and upper left holes relocate without an issue. Lower right and lower left no dice. It won't move these because the sketcher won't accept negative values and a positive value moves it off the block. Also, it takes more clicks to locate the holes. Just don't see the improvement. Maybe still better than other systems but ...
RE: NX 5 Hole feature launches sketcher ???
RE: NX 5 Hole feature launches sketcher ???
As for you sketch dimension issue and not being able to edit the 'zero' values in such a manner that you get your desired result, from the NX 8.0 'What's New' document:
Sketch dimension enhancement
What is it?
Perpendicular, Horizontal, and Vertical driving Sketch dimensions now maintain their direction when the expression value is set to zero. You can also enter negative values for these three driving dimension types to achieve the same results as using the Alternate Solution command.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 5 Hole feature launches sketcher ???
My company works with some very large files. When I wanted to update the location of a hole or series of holes in the past, it was as simple as changing the dimension of a datum plane. Having to edit a sketch from inside a large assembly to change my hole locations wreaks havoc on our systems.
I don't know....maybe I'm doing something wrong. I will have to go back and revisit the newer hole command until I am more familiar with it.
John B. Conger
Tool Design
Automotive Interiors
Advanced Engineering Solutions Inc.
http://www.advancedinternational.com/
RE: NX 5 Hole feature launches sketcher ???
So in the case of a series of holes created using a sketch, when you edit the holes, whether you use the simple 'Edit Parameters' option or you use 'Edit with Rollback', when the Hole dialog is activated you will see all of the dimensions used in the sketch to locate the holes even though you are not actually in the sketch task. At this point you can simply select any of these displayed dimensions, edit the value and the location of the hole will update. The only time that you will need to enter the sketch task itself is if you wish to add or remove holes, or you need to edit the original scheme used to define the location of the holes.
In fact there's even a general purpose option in NX 7.5 where you can temporarily 'turn on' the sketch dimensions used to create a feature without having to even enter the feature edit dialog. And while these dimensions are displayed they can be edited and the model will update.
And we can go even one better by making the sketch dimensions into PMI dimensions (which in NX 8.0 can be done right from inside the sketcher as you're adding them), and since PMI objects can be ON all the time, if I'm in modeling I can simply double-click a PMI dimension and if it's a driving dimension (which sketch dimensions are by definition) I'll be able to edit its value right there without having to first open any sort of dialog or launch an explicit edit operation.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: NX 5 Hole feature launches sketcher ???
Thanks for the feedback.
John B. Conger
Tool Design
Automotive Interiors
Advanced Engineering Solutions Inc.
http://www.advancedinternational.com/