Dimension TFR-TRI view in NX6
Dimension TFR-TRI view in NX6
(OP)
I am having trouble adding dimensions to my drawing in NX6. My model view is TFR-TRI in drafting. Since my dimensions aren't angled properly with the lines in the drawing, I am not coming up with the right numbers. I have tried using "Parallel", "Perpindicular", and "Thickness" dimensions but nothing seems to work. Any ideas? Thanks.





RE: Dimension TFR-TRI view in NX6
If you don't have the PMI module, what you need to do is add the dimensions to your Modeling Trimetric view while the drawing is NOT being displayed where you can control the origin and orientation of the WCS since the the XY plane of the WCS is where the dimensions are placed and from which the projected points are measured. If you need to place dimensions on more than one orientation plane, you will have to move the WCS around as you create dimensions (you have to do a similar thing with PMI except there you only need to get the orientation correct as the origin is not as critical as it is when placing 'drafting' Dimensions in the 3D model view).
In either case, once you have the dimensions placed in your Modeling Trimetric view you simply add that view to the Drawing. For PMI dimension, you will need to select the view and in the Style dialog set the Inhert PMI options, while is you had placed simple Drafting Dimensions they should appears without any extra steps.
Below is an example I created using NX 6.0:
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
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To an Engineer, the glass is twice as big as it needs to be.
RE: Dimension TFR-TRI view in NX6
RE: Dimension TFR-TRI view in NX6
That being the case, let me try to explain how this works...
Unless you have the PMI module, you will need to enter Drafting but turn off the display of the drawing. Now set the view to be the one that you wish to add to your drawing (is you have to create a new saved view so that you have something that you can work with later when you create your drawing. Now while IN Drafting, but without the drawing displayed, you will need to move the WCS around as you create normal dimensions so that the dimensions both measure the correct distances (all dimensioning is done relative to the XY plane of the WCS) and are placed on the correct 'plane'. Once you've add all of your dimensions and notes, now turn the drawing display ON, and add a Base View selecting as the view the one which you were just working in. Note that you will need to completely finish adding ALL the desired dimensions, notations, symbols, etc. to the view BEFORE you add it to the drawing. Anyway, if you did thos correctly, you will have a view which looks similar to the image I posted in my last reply, at least with respect to how the dimensions are displayed.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Dimension TFR-TRI view in NX6
-Is there a reason why you don't mention the "expand view" option?
The general problem is that the sizes of all drafting objects / settings needs to be scaled in reverse to the view scale.
Regards,
Tomas
RE: Dimension TFR-TRI view in NX6
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Dimension TFR-TRI view in NX6
Any tips on this ?
RE: Dimension TFR-TRI view in NX6
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.