×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

CAM: What affects tool path precision?

CAM: What affects tool path precision?

CAM: What affects tool path precision?

(OP)
What would cause NX to give me a .0002 taper on a horizontal path?
I've checked my model. The sketch curves creating the diameter are constrained horizontally, and the diameter at each end is Ø.6275. However, in my posted code the tool path starts at Ø0.6276 and ends at Ø0.6274.

Here's the operation in question:

N60(FINISH_.6725)
G00T0404
(DNMG331-PP IC908)
(DDJNR163D)
G50S1000
G96M03S400
M08
Z0.1
X1.
Z-1.806
X0.6726
G01X0.6724Z-2.7346F.005
G00X1.
Z0.1
X12.
Z2.
M09
M00

The model is properly aligned with the MCS.

RE: CAM: What affects tool path precision?

(OP)
Well, I figured it out with the help of a friend. I'll answer my own question in case anyone else has a similar problem.

The taper was happening because Allow Undercut was toggled ON. (Path Settings > Cutting Parameters > Strategy tab > Cutting).
Why the taper on a horizontal path? I have no idea. In any event, toggling Allow Undercut OFF got rid of the taper for me.

One problem solved, but now my code was giving the path .0001 undersized. The coded path was X0.6724, but the diameter of the part was actually Ø0.6725. That was corrected by changing the Linear Motion Resolution of the post in Post Builder to .00005 (from .0001). smile

 

RE: CAM: What affects tool path precision?

I was having a similar problem with a fixed contour operation that was not quite what I expected.  My intol/outtol was set to .0002 but the tool movements were not as accurate as I needed.  GTAC told me the default modeling tolerance of .001 was the cause of the issue.  I was surprised that a tolerance had to be set in modeling to affect manufacturing accuracy but it did the job.  My tool path positioning immediately showed improvement.  

nx7.5
CNC Programmer
  

RE: CAM: What affects tool path precision?

It also could be caused by the post tolerancing.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources