×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Machining undercuts

Machining undercuts

Machining undercuts

(OP)
Can anyone help me figure out how to machine the undercut areas of this part in 7.0 or 7.5 with a 3-axis machine? In I-deas I would have used a T-slot cutter with a profile cut but in NX I can't get anything to hit the undercut regions.
Thanks, JohnK

RE: Machining undercuts

If I'm seeing it correctly it looks like 2d work, in which case planar milling would do fine. You'll want to go to the "more" tab in cutting parameters and make sure "prevent
undercutting" is toggled off. Also, "part safe clearance" determines how close the system will allow the shank to get to the part. If you can post your part with the tool you want to use I'm sure someone would attach an operation for you.

Ray S
NX 7.0.1.7
www.appliedprecisionproducts.com

RE: Machining undercuts

(OP)
Dang it, that looks like what I want and I tried Fixed Countor, Surface Area but couldn't make it work. I need to study the example to see where I went wrong. On a side note , where did you find that on GTAC? I can't seem to find this kind of thing on their site. Thanks a million, at least now I can see that it can be done, I was starting to worry.

RE: Machining undercuts

If the undercuts are cylindrical I'd still use Planar Mill - Profile. Create a face or plane for your Floor (since the face is slightly non planar. Use the edges for Part. I assume you're going to finish real floor the with a bullnose anyways?

--
Bill

RE: Machining undercuts

When I say gtac, I mean the user group. I've had to deal with a lot of undercut issues so when anyone ever uploads a file with a solution I grab it and save it in my own database.
As for your struggles, surface area has to be worked. Projection vector is usually the issue.
The problem with surface contouring your feature is the sharp corner at the top of the undercut, requiring a special tool that NX probably wouldn't support for surface area. Speaking of which, I noticed both top and btm edges of feature are planar, even though the face is curved. It appears to me you could cut that with a custom form tool and use planar profile. Maybe you'd rather not hassle with that, but I think the sharp corner poses a problem.

Ray S
NX 7.0.1.7
www.appliedprecisionproducts.com

RE: Machining undercuts

Of course that doesn't address fillet at btm. I'd use a std ball mill for large surface and a lollipop style cutter for undercut fillet.

Ray S
NX 7.0.1.7
www.appliedprecisionproducts.com

RE: Machining undercuts

Here's a surface area op for btm fillet. It's programmed for a lollipop/barrel cutter (found it in Harvey Tool catalog), but will also work of course with relieved ball mill. Motion looked right at first but upon closer inspection looked a little squirrelly at points. Ran through verify and sure enough it qouged at .004. Reduced in/out tol and had no effect.

Ray S
NX 7.0.1.7
www.appliedprecisionproducts.com

RE: Machining undercuts

(OP)
Thanks guys, you've been amazingly helpful. I think I'm starting to get a handle on this. Now I just need to buckle down and iron out the details.
Thanks again,
John

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources