Projecting Features from one assembly piece onto another
Projecting Features from one assembly piece onto another
(OP)
Hello,
I am a new user to NX 6.0 and I was wonder how I can project the features (i.e. in my case holes) from one piece, onto another piece.
Thank your very much for your help,
Brandon
I am a new user to NX 6.0 and I was wonder how I can project the features (i.e. in my case holes) from one piece, onto another piece.
Thank your very much for your help,
Brandon





RE: Projecting Features from one assembly piece onto another
I go in the assembly then make the part that I want to add the hole to as the work part (click on part > rmc > make work part)
I then find the hole that I want to project and extract the edge curve of that hole (insert > curve from body > extract > edge curve > pick edge of hole)
Now make the part that the curve was added to the displayed part and you will see the edge curve of the hole in there.
The next time you go into that assembly make sure the assembly is the work part.
rmc > right mouse click
RE: Projecting Features from one assembly piece onto another
Insert -> Associative Copy -> WAVE Geometry Linker...
...and at this point you have a couple of choices, you can either create circles extracted from the edges, using Composite Curves, of the holes in the current part(s) which could extrude and subtract forming holes in the Work part or you could just create Points at the centers of the existing holes which could be used as origins for creating normal holes in the Work part. In either case, the new holes in the Work part will be associatively linked to the original holes in the other part(s).
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Projecting Features from one assembly piece onto another
1) The two different parts where made by different people, and are in different units. I am unable to "make part work part" due to difference in units. How do you change the units of a part?
2)What version of NX are you using. At my company, we are using NX 6.0.
In my version of NX I do not have the option to insert > curve from body > extract > edge curve > pick edge of hole
I have insert/intersect, section. I do not have the extract curve option.
Thank you very much for your time, your help is greatly appreciated.
-Brandon
RE: Projecting Features from one assembly piece onto another
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As for the recommendations, I based mine on NX 6.0 and should work if you follow my proposed workflow.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Projecting Features from one assembly piece onto another
What you can do is go into the model that you want to add the holes to and bring in the other part (that you want to project from) into that model as a component using "assemblies"
If that does not work out for you then you can import one part into the other using parasolids. Let me know if you want to do that.
RE: Projecting Features from one assembly piece onto another
Thank you very much for your time and have a great day!!
-Brandon
RE: Projecting Features from one assembly piece onto another
My problems was that I had my filter to work part only, it should have been entire assembly.
Have a great day everybody, and thanks again for the help.
-Brandon
RE: Projecting Features from one assembly piece onto another
Best Regards
Hudson
www.jamb.com.au
Nil Desperandum illegitimi non carborundum