Noobie.......Break history link?
Noobie.......Break history link?
(OP)
Hi,
I am fairly new to solid works and so this may seem a bsic question to some. I have done some searching but not found an answer to this yet.
I want to break some surface construction history to reduce the clutter in my tree suring concepting.
e.g. In a single part. I want to create a surface offset from a solid face. I then want to untrim this surface. No prob's so far, I can do this. However, I no longer want the original offset trimmed surface.
Can I delete this without deleting the untrimmed surface?
Thanks,
Stuart
I am fairly new to solid works and so this may seem a bsic question to some. I have done some searching but not found an answer to this yet.
I want to break some surface construction history to reduce the clutter in my tree suring concepting.
e.g. In a single part. I want to create a surface offset from a solid face. I then want to untrim this surface. No prob's so far, I can do this. However, I no longer want the original offset trimmed surface.
Can I delete this without deleting the untrimmed surface?
Thanks,
Stuart






RE: Noobie.......Break history link?
In general, if a feature is a child of a feature higher up the tree, then that parent feature cannot be removed from the tree. However bodies (surface and solid) can be deleted from their respective folders. This creates a Delete-body feature which effectively removes those bodies from the tree from that point on, but without affecting any features before it.
RE: Noobie.......Break history link?
Chris
SolidWorks 09 SP4.1
ctopher's home
SolidWorks Legion
RE: Noobie.......Break history link?
If you want to "dispose" of the original surface, youe Delete Bodies. This will get surface body out of the way after you are done using it.
RE: Noobie.......Break history link?
That helps me with solidworks.
I do like the folders option as this is a really nice way to organise and reduce visual clutter.
I was hoping that there may be some functionality like that in catia, where a surface or plane could be "isolated" from its parents. Thereby, allowing items parents to be deleted, leaving a smaller tree, file size and possibly less processing time during updates of large (file size) surface models. e.g. automotive interior lighting lenses, where there are a lot of small optical surfaces.
Thanks for your help and quick responses. Awesome!
Regards,
Stuart
RE: Noobie.......Break history link?
Select the surface body you wish to keep, then perform "Save as --> Parasolid". During the save, you will get a dialog box asking whether to save selected faces or bodies or the entire part.
Once you have your surface exported, delete the parent features and re-import your surface.
http://www.EsoxRepublic.com-SolidWorks API VB programming help
RE: Noobie.......Break history link?
On top of the Feature mgr tree, Right click the part and choose list external refs.
From the list, choose the ref file and then click break button.
RE: Noobie.......Break history link?
Scott Baugh, CSWP![[pc2] pc2](https://www.tipmaster.com/images/pc2.gif)
FAQ731-376: Eng-Tips.com Forum Policieswww.scottjbaugh.com
RE: Noobie.......Break history link?
Another thing to do would be to select any surface you want removed from surface bodies folder and hit delete key (same as using Delete Body feature.
Delete body will remove it after location in tree but does not remove parent refs like deleting offset feature will.
Michael
RE: Noobie.......Break history link?
Although....Note to SolidWorks....Not as easy as in Catia where you can simply right click on a feature and break history. I find this usefull when it helps me to reduce uneeded construction surfaces during quick concept model building.
Stuart Orrell
SW 2010. CS3
Product Designer and Laser Engraver
www.progressivestudios.co.uk