Assembly Configurations like in Solid Works?
Assembly Configurations like in Solid Works?
(OP)
Good Morning all!
I am trying to create suspension assemblies in one main file. I want to show jounce, rebound, and design positions of different components but not all at once. I used to do this easily in Solid Works by setting up configurations by suppressing certain models and mates. I could then select each differ config to see a different suspension position. Is there any way to do this in ProE?
I am trying to create suspension assemblies in one main file. I want to show jounce, rebound, and design positions of different components but not all at once. I used to do this easily in Solid Works by setting up configurations by suppressing certain models and mates. I could then select each differ config to see a different suspension position. Is there any way to do this in ProE?





RE: Assembly Configurations like in Solid Works?
RE: Assembly Configurations like in Solid Works?
This assumes of course, each of your individual models in the assembly are in family tables themselves.
--
Fighter Pilot
Manufacturing Engineer
RE: Assembly Configurations like in Solid Works?
RE: Assembly Configurations like in Solid Works?
The closest I could get to moving components around by instance was to add the assembly mating dimensions to the table and edit them. If you keep it at 0, it's a mate. If you want to move the part, then enter the offset value.
Oddly, WF 4 does allow you to display mate folders under each compinent, ala Solidworks, but you can't seem to do anyting with them. Maybe WF 5 will have the ability to add them to the FT.
RE: Assembly Configurations like in Solid Works?
David
RE: Assembly Configurations like in Solid Works?
I agree with your method - add a second instance of the component with its own constraint set and swap it in and out.
RE: Assembly Configurations like in Solid Works?
When you assign a constraint to a part surface ProE associates that constraint you applied with the internal surface ID number associated with the component. By inserting in a different component with differnet surface ID numbers (this is not the case for family table parts) you will need to somehow tell proE that although these two surfaces on two different parts are the same they will need to be treated the same with respect to assembly constraints. To do this: place the two components within an interchange assembly and tag the surfaces. Then you can swap out those parts all day long without issue.
Steve