NX5 - how do you lay down dimensions on an iso view?
NX5 - how do you lay down dimensions on an iso view?
(OP)
I have a 3D exploded view (NX5 Drafting) and I would like to add my dimensions in the same iso orientation as the exploded geometry. Is this possible in NX5?
NB. I'm not sure what the license deal is regarding the PMI I don't seem to have any options to 'add dimension' in the 3D environment but I can put in Notes, Symbols & security marking...
There is a pic attached below to illustrate what I mean...
Any advice greatly appreciated...
R.
NB. I'm not sure what the license deal is regarding the PMI I don't seem to have any options to 'add dimension' in the 3D environment but I can put in Notes, Symbols & security marking...
There is a pic attached below to illustrate what I mean...
Any advice greatly appreciated...
R.





RE: NX5 - how do you lay down dimensions on an iso view?
What are we in fact looking at here.
You can do something like that in NX by working inside the expanded view from drafting, or adding all the dimensions in the modelling environment before you add the view to the drawing. You will have a few issues with the scale of the dimensions and text being subject to the scale of the view, and you will need to orient your WCS carefully before placing some of the dimensions.
There is more than one way to do it but probably none that are really intended to be used thus.
Best Regards
Hudson
www.jamb.com.au
Nil Desperandum illegitimi non carborundum
RE: NX5 - how do you lay down dimensions on an iso view?
I-Deas is very good for PMI :) It's actually drawn in I-Deas V12.
Now I need to do the same thing in NX5 - looks like Siemens wants some more money for that PMI bit. I'm checking with the administration to see what we've paid for.
Is there a way of adding in dimensions in that way without a full PMI add on?
Best regards - Rob
RE: NX5 - how do you lay down dimensions on an iso view?
"Good to know you got shoes to wear when you find the floor." - Robert Hunter
RE: NX5 - how do you lay down dimensions on an iso view?
Once the view is on your drawing, select it and press MB3 and select the Expand Member View option. Once the view is expanded you should turn on the display of the WCS and then orient it so that the X (horizontal) and Y (vertical) axis align with face from which you wish to select edges to dimension such as seen in your example image. Note that you will need to move the WCS each time you wish to change the X (horizontal) and Y (vertical) axis orientation of your dimensions. Once all of the your dimensions have been placed, again select the boarder of the view, press MB3 and toggle OFF the Expand Member View option. And this should do it.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: NX5 - how do you lay down dimensions on an iso view?
Thanks very much that is exactly what I wanted, and way easier than I expected it to be as well.
Best regards Rob.