Default view from Base view
Default view from Base view
(OP)
Hello,
Is there a way to switch off the default top view when creating a base view?
More often than not, top view or any other default view is NOT what I need and I have to wait for UG to regenerate a wrong view before I can pick the correct one.
TIA!
Is there a way to switch off the default top view when creating a base view?
More often than not, top view or any other default view is NOT what I need and I have to wait for UG to regenerate a wrong view before I can pick the correct one.
TIA!
UGNX5.0.4.1 MP6 \ WinXP-SP3
Productive Design Services
www.productivedesign.com





RE: Default view from Base view
As a workaround (I've used this on large assemblies)
Open the drawing/assembly structure only.
Add the base view - NX will default to top, but as there is no geometry on the screen, the view will not take a long time to regenerate before you place it.
Select the view you want to place
Place view.
Switch on part.
Update view.
RE: Default view from Base view
The first is to create a set of your own Drawing templates with what you consider your standard views already placed on them (or at least a single base view based on what you would like to do and then just create projections from it as needed).
If you don't want to do that or you consider it impractical (although in the long run that is probably the MOST productive approach to take) you can always set the default display of the view being place to be just a box and while it will still default to 'Top' at least you will not have to 'waste time' waiting for it to come up before you can change to your desired base-view. To change the default from a shaded view to just a box, go to...
File -> Utilities -> Customer Defaults -> Drafting -> General -> Preview
...and change the style to 'Border'. As a compromise, you night want to consider using 'Wireframe'. While it's not as fast as 'Border' it will at least show you the wireframe representation of what will be in the drawing view which can help to assure that you have actually selected the correct view and that it's being placed as you would like to see it. Granted, it's not as unambiguous as a 'Shaded' or a 'Hidden Wireframe' preview, but it is much more efficient than either of them and the wait time before you can change to a different base view will be significantly reduced.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Default view from Base view
When I was looking at this I also noticed that when you do add a view and have the option to use the Orient View Tool it would be nice if in that popup window that F8 would work.
Best Regards
Hudson
www.jamb.com.au
Nil Desperandum illegitimi non carborundum
RE: Default view from Base view
Thanks for the replies.
I already have the
File -> Utilities -> Customer Defaults -> Drafting -> General -> Preview
set as "border", but it still shows a shaded top view when I add a base view. I have checked "user", "site"(read only), and "group"(read only) and they are all set to "border".
As for creating default views, I wish I could do that, but most of our drawings are not square to absolute. So I have to create a new view as a base view.
UGNX5.0.4.1 MP6 \ WinXP-SP3
Productive Design Services
www.productivedesign.com
RE: Default view from Base view
And if you HAVE already defined a custom view, pressing MB3 and selecting the 'View' option will allow you to directly select that view from the list of available views in BOTH the current part file and the master model (those are the views with the '*' in the names).
So while it is true that there is NO option to redefine the default 'base view' ahead of time, there are many options available to you when and if there is a need to use an orientation other than what the 'Top' view would have given you if you had accepted it as is. Please look at the MB3 options available to you when placing your Base View as I think you will find that this can be very efficient and effective way to work, particularly if what you imply is correct that there are no hard and fast best view orientations to start with. I think you find that the 'Orient View Tool' option was added precisely to cover situations like yours. You just need to start using it.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Default view from Base view
"Good to know you got shoes to wear when you find the floor." - Robert Hunter
RE: Default view from Base view
What you're saying is more or less what I was alluding to and yes I think you're probably better than the documentation on this one. What I was thinking is that as soon as you start an empty drawing the system attempts to place and canned view for you. It is perhaps a reasonable assumption but can be a waste of time and a hassle if the data is large and detailed and you just forgot to turn of the shaded view. In fact unless you have your default permanently set to border or wireframe then it is already too late to stop it. I think I'd rather that you had to select add view before the view placement dialog opened up.
Now here's a thing I mentioned that I think would make sense. When you're in 3D model space F8 snaps to the nearest orthographic view or normal to a selected face as you know. The orthographic view possibilities for the F8 button are more numerous than the canned views because they are effectively six multiplied by 4 because it will snap to the nearest 90 degrees of rotation. I just mentioned that it would make sense if when you use the orient view tool that F8 was enabled. The reason that it makes sense to me is because it would save me work and because I practically never have any awareness of what the canned TOP, FRONT, LEFT, RIGHT or BACK views actually are! I work 100% of the time with Space Pilot 3D pointing device and I think many others would probably experience the same thing. It is just a thought that I had that I thought was worth elaborating on, because in reading the topic I was prompted to wonder how infrequently adding the top view turned out to be the correct guess.
Best Regards
Hudson
www.jamb.com.au
Nil Desperandum illegitimi non carborundum
RE: Default view from Base view
As I've stated before, one should seriously consider creating Drawing templates with predefined views. Now for those cases where you want to place all of your own views, but you would like to have 100% control over what and when you place the first base view, try this trick. Create a drawing template with a single small 'Reference' view up in say the left hand corner. Now when you use this template to create your drawing, the system will NOT automatically go into the 'Add Base View' mode, but you can launch it yourself with whatever settings you wish to use. And once your views have been place, just delete that small Reference View and continue to finish your drawing.
Now as to the idea of being able to use F8 in the 'Orient View Tool', that has already been implemented in NX 6.0!
Note that you must first click your cursor in the small preview window so that it 'has focus', but once you do that, the F8 key should work like it does in your normal NX graphics window.
John R. Baker, P.E.
Product 'Evangelist'
Product Design Solutions
Siemens PLM Software Inc.
Industry Sector
Cypress, CA
http://www.siemens.com/plm
http://www.plmworld.org/museum/
To an Engineer, the glass is twice as big as it needs to be.
RE: Default view from Base view
Best Regards
Hudson
www.jamb.com.au
Nil Desperandum illegitimi non carborundum