×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Interference Fit Modeling

Interference Fit Modeling

Interference Fit Modeling

(OP)
Hi All,

How do you model an interference fit in abaqus standard?  I have a bushing pressed into a plate--pretty simple, tet 4 elements (once I get it running midnodes will be added).

Contact surfaces have been created from the element faces, normals checked. Contact pairs created, node-to-surface, no adjustment, small sliding.  Surface interaction defined w/ friction.  

On the "contact interference" card I have v defined as -.1.  As i understand, this will allow the initial penetration.  Op new is defined and that is it.  my result shows a highly strained bushing w/ diplacemenst as high as .5mm.  This is fine, but I get the same result for two different bushings.  One w/ interference and on w/o.

I also get the exact same result if I use the shrink option. It acts as if there is some default interference that it is applying.

My preprocesser is Hypermesh 9.0

Any suggestions?   

RE: Interference Fit Modeling

I would recommend not specifying "v" on the contact interference card and let Abaqus figure it out automatically based on the initial overlap of the two surfaces. I'd also recommend using finite sliding instead of small sliding. So you would have:

*Contact Pair, interaction=IntProp-1
surface1,surface2

...

*Contact Interference, shrink
surface1,surface2

 

RE: Interference Fit Modeling

(OP)
Ok, I think that I got it to work....
contact pair, interaction, name, small sliding
slave surf, master surf

surface interaction, name,
surface behavior, pressure over closesure=hard

contact interference, amplitude=name, op new, type contact pair
slave surf, master surf, -.xxx, _, _,_

This way I get .006 ue.  I think I was just missing the surface behavior info.

With your method (I assume w/o a clearance card), I get .014 ue.

So, I got something, it seems to respond to small changes; but I am not sure if it is correct.

Thanks for the input.

Mark

RE: Interference Fit Modeling

Both methods should give you the same result if the underlying material in each body remains elastic while resolving the interference (and there is no friction). You might want to try both methods with brick elements (e.g. c3d8r) which are much more reliable in a mechanical analysis.

Just to be sure, your two parts start off overlapping? i.e. your bushing is a bit bigger than the hole in the plate that you've placed it in? (And, this is possibly ignorance on my part, but what's a "ue"?)
 

RE: Interference Fit Modeling

(OP)
just got your post, sorry "ue" is my abbreviation of micro strain.  Yes, on my test model, I had the interference modeled in; ie., overlapping surfaces.

On my large model, which has ~25 contact surfaces and four press-fit bushings, I have been getting problems w/ convergence.  I've been using the method that I outlined above. Most of the problems came from small gaps between sliding parts.  Once an intermediate step was added to close this gap I had some success.  Now that I have a working model, S4 and Tet4, I tried to convert it to 2nd order and I am not able to get convergence.  Any ideas?

Mark

PS I do have friction and on my test models, I had the same friction on both.   

RE: Interference Fit Modeling

I would definitely recommend trying a linear brick elements (c3d8r) before trying to simplify your model to shell or tet elements. But there are so many other variables, nobody can say why you're getting errors without seeing the model and results...
 

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources