Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here


Machining Hastelloy B

Machining Hastelloy B

Machining Hastelloy B

I'm having a nightmare turning this Material (Hast B) without getting the "Orange Peel" effect. Does anyone have any Magical explanation on how to reduce the visual effect of this orange peel? Perhaps SFM or tools?

RE: Machining Hastelloy B

"Machining Nickel Alloys"  . A Nickel Development Institute reference book, Series N 11 008

I have not failed. I've just found 10,000 ways that won't work." — Thomas Edison

RE: Machining Hastelloy B

This type of "orange peel" damage if often caused by excessive heat building up in at the point of cut -- some times a very heavy duty soluble oil or straight oil to reduce rubbing friction can do wonders -- you will need a fluid with maximum hydrodynamic lubricity - EP lubricity will probably not be effective

A.R. "Andy" Nelson
Engineering Consultant

RE: Machining Hastelloy B

Thanks for the reply,
I've try many ways to avoid the "orange Peel" I've taken very light cuts even tried cutting .003" and still get the same thing. I also tried cutting with oil to no success I'm starting to think that it's just the Material.

RE: Machining Hastelloy B

Not had any experience with Hastelloy, but I've often found "orange Peel" is caused by edge rubbing and tip dulling, especially on light cuts and found that a smaller tip radius on the insert helps minimise this.


RE: Machining Hastelloy B

Have you reviewed this information from Haynes, the producer of Hastelloy?


The others have identified the issue: too much heat generated by a dull tool.  Are you using carbide inserts?  A premium oil-based lubricant that is formulated for nickel-based alloys?  Have you discussed your application with one of the insert manufacturers like Seco, Valenite, Sandvik, etc.?  The latest generation coated carbide tools are significantly better at retaining a sharp edge, and with proper tool setup, the heat should go with the chip, not remain in the workpiece.

RE: Machining Hastelloy B

Thanks for all the tips. . . I will follow through with all.  

RE: Machining Hastelloy B

Sharp and very stout setup is what you need. Don't push it. Slow.

RE: Machining Hastelloy B

Hi there,my name is Kevin Hanson,Im english but have been living in holland for the last 28 years.The problem your having is a combination of heat build up in the cutting zone,another thing could be that the coolant is not oily enough.Cant think of the english word,I mean make the % as high as possible.What works really well on the super alloys is the Jet Stream Tooling from Seco Tools in combination with the new aerospace grades.I have some customers that turn alot of this material and also Inconel 718.The results that you can achieve with this a fantastic.   I,m a cutting technology engineer for Secohier in Holland.regards Kevin.

RE: Machining Hastelloy B

If I remember rightly about this material, you have to use carbide tips for alloy steel and when you machine it, never dwell or the material starts to harden i.e machine it like you mean to, dont mess with it.Also, slow down as this stuff seems to toughrn off if you get it too hot.

RE: Machining Hastelloy B

hi 1wise.like said it could be a problem with the material itself but I dont think thats likely.I machine a lot of super alloys when doing tests and troble shooting here in holland for Seco Tools.You should really use sharp very positive inserts.PVD micro grain inserts.

RE: Machining Hastelloy B

what is the machine, feed & speeds?
what type of coolant/
what type of holder & inserts.

I use to work with this stuff it does not not like small
feeds rates & depth of cut. Work Hardens like hell.

.015 min depth of cut when finishing.very very slow with carbide, , very fast with ceramic.
.050-.060 or more depth of cut with ceramic inserts.
depending on the rigity & horspower of your machine.
surface feed depends on the inserts.

Recommended from the Machining Hand Book  Volume 1

Annealed or Solution Treated.
Carbide inserts C-2 grade, depth of cut .030, 100 SFPM , feed.005-.007 IPR
Carbide inserts C-2 grade, depth of cut .100, 90 SFPM , feed.005-.007 IPR

RE: Machining Hastelloy B

only engage 10% to 15% of the cutter cutting edge to allow it to cool

The trick here is to do the RPM's per the cutters diameter and composition, which determines the surface feet. Then you can go fast as feed will permit and or finish requirement allows. However, only engage 10% to 15% of the cutter cutting edge to allow it to cool. I, myself didn't believe it at first. But I saw it with my own eyes and was amazed.

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Close Box

Join Eng-Tips® Today!

Join your peers on the Internet's largest technical engineering professional community.
It's easy to join and it's free.

Here's Why Members Love Eng-Tips Forums:

Register now while it's still free!

Already a member? Close this window and log in.

Join Us             Close