remove solid object from view
remove solid object from view
(OP)
Hello,
UGNX3 Windows XP SP3
How do you remove a solid object from a view?
I have two files, one model, the other the drawing.
The model is composed of hoses and connectors.
If this is an assembly, I could remove one of the components.
Since the model is one file, whenever I try to blank one of the solids, it affects the other views as well.
TIA
UGNX3 Windows XP SP3
How do you remove a solid object from a view?
I have two files, one model, the other the drawing.
The model is composed of hoses and connectors.
If this is an assembly, I could remove one of the components.
Since the model is one file, whenever I try to blank one of the solids, it affects the other views as well.
TIA
Productive Design Services
www.productivedesign.com





RE: remove solid object from view
If you want to remove it just from that view you can put it on a differnt layer and use "visible in view".
You can also erase just that solid body from the view (located in view dependent edit).
If you do erase it then make sure only "solid body" is toggled on so that it picks the entire body and not just the solid edges.
RE: remove solid object from view
Yes I cannot blank it without affecting the other views.
I would prefer to leave the layers "as is".
When I try to erase using "view dependent edit" and try to select the solid, it won't let me. When the selection filter is set to any, I could select the edges/curves on the view.
If set to solid, I can't select anything.
Model representation is "part" and is fully loaded.
If I go to modelling and try to blank the solid just to test if it is really a solid, it works.
Productive Design Services
www.productivedesign.com
RE: remove solid object from view
I got the view set as "extracted edges"
When I removed the check mark, it works now.
Thanks!
Productive Design Services
www.productivedesign.com
RE: remove solid object from view
I will often use this command on assembly drawings where I have an exploded view and an assembled view. I can select all the interior parts from the exploded view and make them hidden in the assembled view. This speeds up subsequent view updates on the assembled view.
RE: remove solid object from view
RE: remove solid object from view
Since that is the case, ignore my post - jerry hit it on the head.
RE: remove solid object from view
You would be better to split the single assembly file into two assemblies all things being equal just to make it work better. Then you can hide components in views with little or no trouble.
What I would do is to move one of the solids to another layer in the drawing only. Then I'd set visible in view on the drawing views. The practical advantage of this is that we often wish to create a drawing of a part or assembly that is already released. Our released parts are write locked so you can't alter the layers, reference sets, or assembly structure to suit your drawing requirements. That is why we conform to a standard which uses layers on occasion to maintain the independence of model and drawing requirements. Best practice is always to assign categories to the layers you use and work within a predefined accepted standard.
Best Regards
Hudson
www.jamb.com.au
Nil Desperandum illegitimi non carborundum
RE: remove solid object from view
"Good to know you got shoes to wear when you find the floor." - Robert Hunter
RE: remove solid object from view
Anyways, here is what I did.
I just use the "view dependent edit" to "erase" the solid object.
The first time I tried this, I can't select the solid object.
This is because when I created the views, I have "extracted edges" checked. I forgot about this. I usually leave this checked so that when someone looks at the drawing file without the model file, they could still see the views.
I can't move the solid objects to different layers because GM wants the solid geometry that defines the part in layer 1.
I would have preferred to have a model file for each solid object (which I think is the proper way) but the file came "as is" from our customer and they do not want us to modify it. Just create the drawing.
Productive Design Services
www.productivedesign.com
RE: remove solid object from view
GM want the Solid object that creates the part on layer 1 of the model. You can move the solid body to another layer in the drawing file while leaving it on layer 1 in the model file. For the drawing there is no such applicable standard. And this allows you to set visible in view masks. Either that or your office is interpreting the standards entirely differently to what we have been held to in the past.
I know what you mean about supplier assemblies and I agree to some extent. The problem is that somebody came up with a formula that says it costs so much per part to create a part number and so they simply want to maintain fewer files on their system. The result is that you have things called assemblies that consist of models with multiple solids, and no components. The language gets confusing.
Best Regards
Hudson
www.jamb.com.au
Nil Desperandum illegitimi non carborundum
RE: remove solid object from view
I remember doing it on another program where I have the side marker on a layer and the sheet metal that it attaches too on another so I can control what is visible on a view using layers.
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