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Assembly Design

Assembly Design

Assembly Design

(OP)
The problem I am having is every once in a while when working in an Assembly I will get a component that will not let me select any external references from any other part.  For example I am trying to create a sketch in a component and it will not let me select any face or plane from another component in the assembly it will only let me select these features from the same component I am in.  I find this happens every so often and I still cannot figure out why?  Other components work just fine.  Please Help

RE: Assembly Design

You have Keep links with selected object turned on in tools --> options --> infrastructure -->part infrastructure - general.  You can link information in 1 direction - meaning you can link from A - B or B - A but never A - B and B - A.


Regards,
Derek
   

RE: Assembly Design

(OP)
so when I turn that off everything I create is a broken link so I must turn it back on when I want to have a link again?  I understand the reason why you shouldn't link a-b then b-a but do you continuously have to toggle this on and off?   

RE: Assembly Design

Well, on that same options page turn on Restrict external... to publications.  This will only allow you to link to published items.  This is a best practice method.  There should be enough posts on this if you do a search on publications.
You can create datum items in your Part B from Part a by turning on the Create datum button before you create the geometry.  Copy/Paste as Result would work as well.
 

RE: Assembly Design

Could be a contextual isssue as well. The part you are working on might be "out of context" which will not allow you to select things in other parts.

RE: Assembly Design

Jackk is correct.  Look at the little gear on the Part Icon - is it green or white?  Or is it brown?  This will tell you whether or not the part is "in context" and can have new links added.   

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