SPHERES IN ASSEMBLIES
SPHERES IN ASSEMBLIES
(OP)
I HAVE AN ASSEMBLY WITH A VALVE BALL IN IT, AND I CANT SEEM TO CONSTRAIN IT ANY WHICH WAY, ANY SUGGESTIONS
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RE: SPHERES IN ASSEMBLIES
bc.
2.4GHz Core2 Quad, 4GB RAM,
Quadro FX4600.
RE: SPHERES IN ASSEMBLIES
IR#5703969 (How to locate a ball on the end of a tube?)
connect relationships or tangent can also work in some situations.
Tangent is not part of the automatic options you must choose it.
RE: SPHERES IN ASSEMBLIES
The example shows a connect between two spherical faces.
bc.
2.4GHz Core2 Quad, 4GB RAM,
Quadro FX4600.
RE: SPHERES IN ASSEMBLIES
if you don't have access to GTAC here is their suggestion
along with a different way to get it 'seated':
In the ball part add a sketch that matches the diameter of the hole that it
will fit into. Then use the sketch to apply a connect relationship.
- or -
In the valve part create a revolved construction surface that matches your
sphere and positioned to 'shut' the hole. Then in assembly connect the ball
to the construction surface of the valve.
dy
RE: SPHERES IN ASSEMBLIES
We're guessing at what you want to do - can you be more specific about the problem, then maybe we can give you a correct solution.
bc.
2.4GHz Core2 Quad, 4GB RAM,
Quadro FX4600.
RE: SPHERES IN ASSEMBLIES
RE: SPHERES IN ASSEMBLIES
I would create a sketch as DY explained but I would use sketch lines that correspond to the axis between the two cylindrical ends. Create a line axis in the sphere sketch as well. You should be able to apply an axial align between all three components of this part of your assembly. This will also allow you to leave the ball under constrained if it is to move between the two cylindrical ends.
Jef
RE: SPHERES IN ASSEMBLIES
the axial align will leave 2 degrees of freedom (vertical
movement, rotation) and thus will center the ball but will
not 'seat' it
The circle method will leave 1 degree of freedom (rotation)
but will 'seat' the ball.
So which method to choose depends ..
dy
RE: SPHERES IN ASSEMBLIES
In the part file create a co-ordinate system at the centre of the ball.
In the assembly file create a co-ordinate system at the centre of one end of the cylinder.
Use the 'match co-ordinate systems' method to constrain the ball. This will create 3 alignment constraints. Adjust one of them to offset the ball the required distance from the cylinder end.
bc.
2.4GHz Core2 Quad, 4GB RAM,
Quadro FX4600.
RE: SPHERES IN ASSEMBLIES
RE: SPHERES IN ASSEMBLIES
All you do with this command is pick the two systems - it's probably the simplest method of constraining in Solid Edge.
To get the 2 systems displayed RMB on the two parts and select 'Show/Hide Component >> Co-ordinate Systems'
Similarly for sketches.
In my last post I said create a system in the assembly file at one end of the cylinder - it may be better in the part file.
bc.
2.4GHz Core2 Quad, 4GB RAM,
Quadro FX4600.
RE: SPHERES IN ASSEMBLIES