CATIA V5 Drawing links replace
CATIA V5 Drawing links replace
(OP)
Does anyone know, how can I replace drawing links correctly?
Thanks.
Thanks.
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RE: CATIA V5 Drawing links replace
Forever Young
RE: CATIA V5 Drawing links replace
Take a look at this post.
http://www
Regards,
Derek
RE: CATIA V5 Drawing links replace
Open the 3D model.
Open the drawing and drawing as active document:
Edit / Links
Replace / With loaded document
Sometimes (if error occures) you have to first remove the links and then try again.
RE: CATIA V5 Drawing links replace
in case of the uuid is not same, can your procedure run?
RE: CATIA V5 Drawing links replace
RE: CATIA V5 Drawing links replace
RE: CATIA V5 Drawing links replace
With a script you can actually change the link of the view but you will have to relink dimension...
To avoid further problem :
When a drawing is made from 3D file A, if you have to change the geometry, use the same 3D file A in order to create 3D file B, then your drawing can be link to 3D file B.
indocti discant et ament meminisse periti
RE: CATIA V5 Drawing links replace
RE: CATIA V5 Drawing links replace
indocti discant et ament meminisse periti
RE: CATIA V5 Drawing links replace
RE: CATIA V5 Drawing links replace
RE: CATIA V5 Drawing links replace
See also http://www.eng-tips.com/faqs.cfm?fid=1318
Regards
Fernando
RE: CATIA V5 Drawing links replace
RE: CATIA V5 Drawing links replace
I always use save management when trying to maintain links. Since you haven't changed file b in any way it should be the same as file a, correct? Since the drawing was created from file a you should be able to use save management to save both as new file b. I always start with a fresh session of v5, open both the part and drawing and then you can right click on the drawing and select all pointed. You will see that the part will highlight with the drawing showing they are linked. Using the pattern name type *-rev1 (just an example) then select apply pattern. Both the drawing and part will have -rev1 added to the end of the part name. You will be able to see the path it will save to in the next column. Now do a save as on both of the files to a directory (example //part#-rev1). Make sure the new path shows up in the location column and action states "save" on both of your files then select ok. If the save as is greyed out you have to click in the epmty area below the parts to deselect the files. I always exit out of catia and open a new session and the new files as a sanity check.
Hope this helps
RE: CATIA V5 Drawing links replace
RE: CATIA V5 Drawing links replace
This especially does not work out if the drafting goes at a differnt end than the design end. When a designer updates his design again and again with the modifications and sends the file(which is a with a new name(that name with rev added), certainly with a different uuid. But the drawing at the other end does not accept this new file.
Moral of the story is: Like parent child relationship. its always catious of working on only one design file that has been used previously for creating this drawing. So, keep shuffling the same design model file between drafter and designer.
Do you understand? or Have I confused you further?
Thanks,
CatMann
RE: CATIA V5 Drawing links replace
You can have 1000 files with the same UUID.
Forever Young
RE: CATIA V5 Drawing links replace
I also thought it was stupid because you could use the same drawing format even views and sections in v4 and save a lot of time.
But even more annoying is that sometimes you get the "drawing refused the link" without any reason. In fact I shouted and called one of our designers an idiot because I thought he had broken the link by doing a "new from" but I was wrong he managed to relink it from a new location to the released and locked file. I felt really bad about it because I thought it was impossible to cheat the system.