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show removed material?

show removed material?

show removed material?

(OP)
I'm detailing a part to be made from a commercial sprocket.  The model shows it in modified form, with most of the hub parted or faced off.  I want to show and dimension the material that _used_to_be_there_ to give the bidder a fair picture of how much metal must be removed.

The way I'd do it on paper is a couple of phantom line rectangles in a section view, a reference dimension, and a flag 'remove', or something like that.

What is the SW way?

Mike Halloran
Pembroke Pines, FL, USA

RE: show removed material?

Make a new configuration and use Alternate View in the drawing to get your phantom lines to dimension to.

"Art without engineering is dreaming; Engineering without art is calculating."

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RE: show removed material?

Also note that alternate position views are only available for views of an assembly.  If you want to take the alternate position route you'll have to make a single-part assembly file.  Alternately, it sounds like what you're wanting would be pretty simple to sketch up with sketch entities directly on a drawing view.  You can change the font and weight of sketch entities pretty easily.

RE: show removed material?

You can also use the geometry compare function in SolidWorks Utilities if you have SolidWorks Office Pro or Premium.  We use this for casting and machining checking.  We model castings in their own part file.  We then insert the casting as a base part in a machined part file.  We perform the machine aspects on this part model.  We can then compare the geometry between the cast and machined part models and see the results on screen.  You can save the results off to a separate file and measure the material being removed.  This mode of working is very clean, very stable, and has benefits for using with geometry compare.

Pete

RE: show removed material?

(OP)
Thanks, guys.

I put a sketch on the drawing view.  So far so good.


Mike Halloran
Pembroke Pines, FL, USA

RE: show removed material?

When I do this (i.e. with machined castings), I use a 3D sketch to extract the edges of the faces that are to be removed.  Then I can use the sketch entities to draw and constrain phantom lines in the drawing.

batHonesty may be the best policy, but insanity is a better defense.bat
http://www.EsoxRepublic.com-SolidWorks API VB programming help

RE: show removed material?

Handleman, thanks for the "Assembly use only" catch, it was early for me.

"Art without engineering is dreaming; Engineering without art is calculating."

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RE: show removed material?

I prefer TheTick's method as the information is kept with the model and is associative if the "blank" is changed.

If a part is created from another (blank or purchased part), I would insert that as a base part and remove material as required.

cheers

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