Solidworks to Catia
Solidworks to Catia
(OP)
getting use to Catia fast but coming from Solidworks its not as friendly. Q. Is there a Equal contraint? when doing sketches and such I use to like to draw the circles or other geo and the geo that was alike I would click all the geo and add a equal constraint. Cannot seem to find it.





RE: Solidworks to Catia
here is my list of solidworks to cata questions:
1. can I customize key strokes to pull up tools?
i.e. "line = Cntrl+L" or "dimension = Alt+D"
If not...I am going to hate this program for a few more weeks!
2. can I "convert" a line from a previous sketch (or a edge of a previous solid) into a line into my new sketch?
3.I guess that is all for now...
any help for us solidworks to catia guys would be great thanks!
RE: Solidworks to Catia
2. Can I "convert" a line from a previous sketch (or a edge of a previous solid) into a line into my new sketch?
A: Yes, it’s a tool called "Project 3D elements", it can be found in sketcher. This will project edges of a solid.
It will not project the outside of a cylinder however, to do this, you must use "Project 3D Silhouette Edges"
RE: Solidworks to Catia
RE: Solidworks to Catia
RE: Solidworks to Catia
Formula is uni-master i.e. you must change the driver to update
RE: Solidworks to Catia
I even asked about this in training and they told me 'edit formula' was the only way to do it.
Bob
RE: Solidworks to Catia
Lets say in SW I wanted to add a feature to a part. But I wanted to add it before another one I would simply roll back the bar by moving it up then add the feature. roll back down and if anything blew up I could then fix it.
With Catia I have not found the same situation available. I know it must be there but do not have to many here to ask q's. to.
Thanks in advance
RE: Solidworks to Catia
Right-click on the feature and choose "Define in Work Object." This will underline the feature, and the next feature you add will be added after the underlined feature.
When you're done, define the last feature (or the top Part Body) as the Work Object.
RE: Solidworks to Catia
RE: Solidworks to Catia
i.e. "line = Cntrl+L" or "dimension = Alt+D"
If not...I am going to hate this program for a few more weeks!
2. can I "convert" a line from a previous sketch (or a edge of a previous solid) into a line into my new sketch?
"
1. Right click in the toolbars and go to "customize". Go to the "Commands" tab and left column choose "all commands". Right Column find your command and click "show properties" and put your keystroke in the "accelerator" box.
2. Yes! In sketcher, in the operation toolbar(the one with fillet and chamfer). at the end of the toolbar, expand the last one, and there is "Project 3D elements" click your elements then click that button to use it.
RE: Solidworks to Catia
RE: Solidworks to Catia
Regards,
Derek
RE: Solidworks to Catia
RE: Solidworks to Catia
In SW I could build a configuration of a part and then another and switch between the two or more. What is the terminology for me to search by and if you have any pointers to add. I believe it to be called "scenes" not sure of that.
RE: Solidworks to Catia
Regards,
Derek
RE: Solidworks to Catia
RE: Solidworks to Catia
DBezaire is correct about scenes, they do not change part configurations in any way. To control configurations, investigate Design Tables. I recall there being some good tutorials in the help files.
Cheers,
Mark
RE: Solidworks to Catia
I HAVE INADVERTENTLY TURNED ON SOME KIND OF VISUALIZATION FEATURE WHICH HIDES EVERYTHING WHICH IS NOT AN "IN WORK OBJECT" THIS WOULD BE A REALLY USEFUL FEATURE IF ONLY I KNEW HOW TO TURN IT ON AND OFF.
I ASSUME IT IS A FEATURE AND NOT SOME KIND OF GLICHE
CAN ANYONE ENLIGHTEN ME
RE: Solidworks to Catia
Create datum - if active creates "dumb" items.
Only Current Body - there are a few options under this. I think since R17. Also some toggles in Tools --> options --> Infrastructure --> Part Infrastructure --> Display. Display in Geometry area.
Regards,
Derek
RE: Solidworks to Catia
RE: Solidworks to Catia
Go here
http://2htts.com/CATBlog/?&blogid=1
look up Parameters&DT with macro
download this example.
Regards,
Derek