×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Shouldn't the thid strain compenent vanish in the plane strain case

Shouldn't the thid strain compenent vanish in the plane strain case

Shouldn't the thid strain compenent vanish in the plane strain case

(OP)
My part is: 2D Planar,  Type: Deformable with Homogeneous Solid section. Upon checking the results i found remarkable value for E33. How this can happen in the plane strain section.?

RE: Shouldn't the thid strain compenent vanish in the plane strain case

Actually, only the kinematic strain in the third direction are zero.

If you have plasticity, the constitutive algorithm will give something like EE33=-PE33 and LE33=EE33+PE33=0

Also, if you assigned a local orientation to the material different than the global system then the program will supply the results in local orientation.

RE: Shouldn't the thid strain compenent vanish in the plane strain case

HI xerf,

If you mean the material is purely elastic, no plasticity, EE33 should be zero?

RE: Shouldn't the thid strain compenent vanish in the plane strain case

Yes. If the material is purely elastic then EE33=0 if 3 refers to the global 3rd direction.

RE: Shouldn't the thid strain compenent vanish in the plane strain case

For generalised plane strain however the strain isn't zero but is some constant value, not necessarily zero.

corus

RE: Shouldn't the thid strain compenent vanish in the plane strain case

For the generalized plane strain section, the formulation implemented in ABAQUS assumes the material is bounded by two rigid planes in the 3rd direction.

If the two planes are parallel to each other then the strain component in the 3rd (out of model plane) direction is constant.

However, the ABAQUS formulation allows relative rotations (with respect to the reference point of the part instance) between the two planes. In this case, the current thickness of the section depends on the coordinates (x,y) and so does the strain component in the 3rd direction, which is computed as:
strain33=ln(current_thickness/initial_thickness)

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources