×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

nonlinear buckling analyse

nonlinear buckling analyse

nonlinear buckling analyse

(OP)
Hi,

I do a set of nonlinear buckling analyses via APDL. I use shell181 and mpc 184. In some analyses the reason for termination was unconverged solution :

R E S T A R T   I N F O R M A T I O N

 REASON FOR TERMINATION. . . . . . . . . .UNCONVERGED SOLUTION

but for another ones :

        R E S T A R T   I N F O R M A T I O N

 REASON FOR TERMINATION. . . . . . . . . .ERROR IN ELEMENT FORMULATION

...what does this mean ? Are results in this case valid (they seem to be valid) ? Did I set up something wrong ?

Regards,
Lubo

RE: nonlinear buckling analyse

Hi,
I don't know what you mean by "they seem to be valid", since normally both error messages are typical of a "wrong" solution.
Bear in mind that, when you are doing several sub-steps in sequence and you request results for every sub-step, the displayed solution is the last converged one at the last equilibrium iteration. It is identified by the fictitious sub-step number "999999". This may or not contain info about the solution failure.
"Unconverged solution" means that, at a certain point of the analysis, it was not possible to find an equilibrated force field to match the compatible displacement field. "Error in element formulation" comes when, for some reason, at least one element violates its mathematical formulation (e.g. the Gaussian nodes have come outside the domain defined by the "physical" nodes), because of what happened to the displacement field: that means that no compatible displacement field exists (or seems to exist).

I'm about sure that you already know that, for a non-linear buckling analysis, the first non-converged sub-step is the one for which the critical load has been exceeded, so this kind of termination is quite normal.

Hope this helps...

Regards

RE: nonlinear buckling analyse

(OP)
Hi,

Thank you for your reply cbrn ! I hoped that the answer will be as you wrote. I set these values for solution (the end of the previous load step is time = 6):

NCNV  , 2
LNSRCH, 1
TIME  , 46
AUTOTS, ON
NSUBST, 160,2000,160
NEQIT , 40

solution started with (46-6)/160 = 0.25 time increment, the last increment was 40/2000 = 0.02. In this increment 40 iteration was performed and then the solution was terminated. But I have just one more question. I realised that after the first bisection the next time increment was 0.1125 instead 0.25/2 = 0.1250. Why ? I thought that "bisection" means to divide by two. Is the reason relative to another used setings (LNSRCH, 1, AUTOTS, ON) ?

Regards,
Lubo

RE: nonlinear buckling analyse

Hi,
I don't remember how Line Search exactly works, but it has to do with secants, so depending on the slope / convexity of the curve, the bissection can lead to a timestep which is not half the previous one. This is the advantage of the Line Search wrt the "traditional" timestep division.

Regards

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources