×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Coupling Shell/Sold elements

Coupling Shell/Sold elements

Coupling Shell/Sold elements

(OP)
Hi all,

I am using Ansys classic to model the mecanical behavour of a membrane. The assembly is composed by a strongback (it looks like a square mesh), in this part, a thick film of polymer is glue and a pressure is applied.
So to model with Ansys the mechanical behavour, I use solid element for the strongback and shell element for the membrane. My problem is to model the contact between the membrane and the strongback. I would like to know if it is better to use the CP command or the contact wizard?

The aim of this study is to know the influence of stiffness of the strongback.

Thank you for your help

RE: Coupling Shell/Sold elements

I would try two variants:

1. No contacts and no cp's. Just Mesh the area with shels and then the volume with tets

2. Contact elements with friction

Then compare the results. I assume that the first variant will give similar results with variant 2.

Regards,
Alex

RE: Coupling Shell/Sold elements

You could also try using the SOLSH190 elements.  They are 8-noded brick elements with a shell formulation.  Then, all you have to do is glue the volumes together, and the DOFs will be transferred across through the shared nodes.

Hope this helps,
Doug

RE: Coupling Shell/Sold elements

(OP)
If I do not use some CP's or contact elements, the membrane is not supported any more by the strongback. Probably I do not understand waht you mind...sorry for my english...

This is my apdl file with a simple geometry and with no contacts and CP's, it probably help you to understand my problem.

Regards,

FINI
/CLEAR  
/TITLE,  
/PREP7
!______________________________________________________________
       !!!!Parametres
*SET,e,0.003
*SET,em,0.000015        
*SET,p,350000      
*SET,a,0.052         
*SET,l,0.003     
*SET,b,0.005     
!______________________________________________________________
           !------------------------------------------!
           !            MATERIAU 1=PP    Pa           !
           !------------------------------------------!
!MATERIAU 1=316LN Pa
UIMP,1,EX, , ,193E9,
UIMP,1,DENS, , ,8000,   
UIMP,1,NUXY, , ,0.272,
ET,1,solid95

!MATERIAU 2=Film PP
UIMP,2,EX, , ,100E9,
UIMP,2,DENS, , ,8000,   
UIMP,2,NUXY, , ,0.49,  
ET,2,SHELL93
R,2,em, , , , , , !epaisseur membrane
           !------------------------------------------!
           !                Geometry                  !
           !------------------------------------------!
RECTNG,a/2-e/2,a/2+e/2,0,a,
RECTNG,0,a,a/2-e/2,a/2+e/2,
AADD,1,2
VOFFST,3,b,,
RECTNG,0,a,0,a,

ESIZE,e,0,
MSHAPE,1,3D
MSHKEY,0
VSWEEP,1

AATT,2,2,2,0,
*DO,i,0,3
  LESIZE,37+i,,,19,
*ENDDO
MSHAPE,0,2D
MSHKEY,0
AMESH,15
           !------------------------------------------!
           !                Loads                     !
           !------------------------------------------!     
SFA,15,,PRES,(100000),,
   *DO,i,0,3   
      DL,37+i,15,ALL,0,0
   *ENDDO
   *DO,i,0,3
DA,4+3*i,ALL,,
   *ENDDO
FINISH

/SOL
!NLGEOM,ON
SOLVE
FINISH




RE: Coupling Shell/Sold elements

You must first mesh the areas and then the volumes!

CODE

FINI
/CLEAR  
/TITLE,  
/PREP7
!______________________________________________________________
       !!!!Parametres
*SET,e,0.003
*SET,em,0.000015        
*SET,p,350000      
*SET,a,0.052         
*SET,l,0.003     
*SET,b,0.005     
!______________________________________________________________
           !------------------------------------------!
           !            MATERIAU 1=PP    Pa           !
           !------------------------------------------!
!MATERIAU 1=316LN Pa
UIMP,1,EX, , ,193E9,
UIMP,1,DENS, , ,8000,   
UIMP,1,NUXY, , ,0.272,
ET,1,solid95

!MATERIAU 2=Film PP
UIMP,2,EX, , ,100E9,
UIMP,2,DENS, , ,8000,   
UIMP,2,NUXY, , ,0.49,  
ET,2,SHELL93
R,2,em, , , , , , !epaisseur membrane
           !------------------------------------------!
           !                Geometry                  !
           !------------------------------------------!

RECTNG,a/2-e/2,a/2+e/2,0,a,
RECTNG,0,a,a/2-e/2,a/2+e/2,
AADD,1,2
VOFFST,3,b,,

! changed:
RECTNG,0,a/2-e/2,0,a/2-e/2
RECTNG,a/2+e/2,a,a/2+e/2,a
RECTNG,0,a/2-e/2,a/2+e/2,a
RECTNG,a/2+e/2,a,0,a/2-e/2
nummrg,kp

MSHAPE,0,2D
MSHKEY,0
asel,s,loc,z,0
AATT,2,2,2,0,
esize,e
AMESH,all
alls

ESIZE,e,0,
MSHAPE,1,3D
MSHKEY,0
VSWEEP,1
! :changed

RE: Coupling Shell/Sold elements

(OP)
mihaiupb, thank you so much for your help.

And now if I want to model the global displacement of the strongback, I must to use the CP's?

RE: Coupling Shell/Sold elements

No CP's are necessary. Lok at the mesh with node numberings on. All Nodes on the interface of shells to solid are common to shells and solid elements.

Regards,
Alex

RE: Coupling Shell/Sold elements

(OP)
The reults with your method are very good !
Thank you for your help Alex !

Cheers

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources