Solid from surfaces? and selection question
Solid from surfaces? and selection question
(OP)
Hi
I need to find a way to "solidify" surfaces.
I have a completely closed surface, made of several surfaces. It passes a healing and a joining, but I don't know how to make a proper solid from it.
another question, how do I select a chain of curves (especially tangent ones)? for instance when making a boundary for joining and so forth.
I need to find a way to "solidify" surfaces.
I have a completely closed surface, made of several surfaces. It passes a healing and a joining, but I don't know how to make a proper solid from it.
another question, how do I select a chain of curves (especially tangent ones)? for instance when making a boundary for joining and so forth.





RE: Solid from surfaces? and selection question
2. extract -> tangent continuity. Then join the extracts.
RE: Solid from surfaces? and selection question
close surface doesn't work, says I need more then 1 planar surface for making it into a solid, but it's really closed since when I export it into step and read it in SW, it imports as solid.
when I extract the curves, and then join them, won't I need to select the curves manually?
TIA
Jake
RE: Solid from surfaces? and selection question
About your solid. You do not need to create a VOLUME (GSO license) a JOIN is OK, check the boundaries or your join, you should not have any. Do some Connect Checker on the JOIN (with internal edge option ON).
Then in PartDesign you have the option to create solid from surface (insert / surface based feature / close volume).
If it works in SW it may be because of the accuracy. What is the result when you open this STEP in V5 ?
indocti discant et ament meminisse periti
RE: Solid from surfaces? and selection question
RE: Solid from surfaces? and selection question
Regards,
Derek
RE: Solid from surfaces? and selection question
Tools->Options->General-Display
Slide over and get to the Visualization tab. The last option with a pulldown is probably not checked on, Surfaces' Boundaries. Check that box on, use the pulldown to change the color to your choice, and the thickness option next to it as well. Use the Shading With Edges option, and it will highlight all the free edges in your surface model. All the closed edges will show black(default here). Once the colored edges are gone, Close Surface in Part Modeler will create the volume with no problem.
RE: Solid from surfaces? and selection question
The tools will always tell you what the gaps are - but it's harder with an overlap. It does not always catch overlaps, and this is a big problem for joining - because you can't catch a discontinuity if it doesn't register as a connection.
begnor - checking the edges is a very good idea. Many people won't do it, however, because it requires WORK. And, it's very challenging on large models.
Nonetheless, it's a very good idea.
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Catia Design|Catia Design News|Catia V5 blog
RE: Solid from surfaces? and selection question
Overlaps are a pain, but the edge highlight will let you know that they are not connected. How one chooses to correct the overlap/gap is up to them. It is a lot of work sometimes, but luckily for me, I am dealing with small surface models that usually don't take more than a day to straighten out.
RE: Solid from surfaces? and selection question
RE: Solid from surfaces? and selection question
RE: Solid from surfaces? and selection question
Boundary is by far one of the best diagnostic tools for surface modeling in Catia V5.
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Catia Design|Catia Design News|Catia V5 blog