INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Member Login

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips now!

Talk With Other Members
Be Notified Of Responses
To Your Posts
Keyword Search
One-Click Access To Your
Favorite Forums
Automated Signatures
On Your Posts
Best Of All, It's Free!

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Donate Today!

Do you enjoy these
technical forums?

Donate Today! Click Here

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Eng-Tips Posting Policies

Jobs from Indeed

jobs by

Link To This Forum!

Home > Forums > Engineering Computer Programs > General Engineering Programs > SolidWorks 3D CAD products Forum

Combine Bodies - Subtract(3)

Read More Threads Like This One

sloth4z (Mechanical) (OP)

14 Jul 06 14:34

I made multibodied part with a shaft going through the center of a plate (two intersecting solid bodies). I would like to cut the union out of the shaft leaving two shafts (one on each side) and a plate. If I use the Combine->subtract option, then the plate disapears. Is there a way to subtract the union from the shaft, but leave the plate? I am using SW2006 SP4.1.

I know of several workarounds for this example, but none that would work with more complicated parts.

(2) rfus (Mechanical)

14 Jul 06 15:13

Use Indent with the cut box checked. You can even put a tolerance in.

RFUS

rfus (Mechanical)

14 Jul 06 15:16

After reading again I think you may want to use combine with ADD and then use the SPLIT feature

rfus (Mechanical)

14 Jul 06 15:26

Freakin Friday.

I meant use Split with the face of your shaft and then do a delete body. So many ways to skin cats.

I'm going home.

CorBlimeyLimey (Mechanical)

14 Jul 06 15:28

Split is the way to go. You will have to play with the options/selections to be left with the portions you want.

cheers
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091

sloth4z (Mechanical) (OP)

14 Jul 06 17:44

Thanks guys.

Here is the process I used.

1. I started with two solid bodies (shaft and plate).
2. Insert->Features->Split
3. I selected both faces of the PLATE, and then clicked on "Cut Part"
4. I selected "Consume Parts" and checked the middle shaft piece.

That worked like a charm. This also works for my more complicated problem as well. I love this forum.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!

Back To Forum

Back To SolidWorks 3D CAD products