280+ MB slddrw file
280+ MB slddrw file
(OP)
i desperately need help trying to salvage a drawing file that i have put together. i recently put together my first large drawing set based off of a 100+ part assembly file. after sub assembly detail sheets, i ended up with a 10 page drawing set. i was monitoring the file size pretty closely and it started growing exponentially. eventually it got to where i have insufficient memory available and i cannot open the file. i have tried everything i can think of. 3gb switch is enabled, i ran ecosqueeze, i have closed and deleted all non-vital files and programs.
is there any way to attack this from outside of solidworks? is it time to delete and start from scratch?
furthermore, are there any thoughts on where i went wrong or what i could do to prevent this in the future?
thank you in advance for your help.
regards,
JEM
is there any way to attack this from outside of solidworks? is it time to delete and start from scratch?
furthermore, are there any thoughts on where i went wrong or what i could do to prevent this in the future?
thank you in advance for your help.
regards,
JEM






RE: 280+ MB slddrw file
There are others here who have worked with large drawings more, but from what I remember of the posts, one technique is to create configurations of the assembly where some of the parts are simplified or eliminated and use the simplified configurations as the source for the drawing views.
Another technique is fewer sheets per drawing file.
Eric
RE: 280+ MB slddrw file
RE: 280+ MB slddrw file
If you don't know of anyone who could do this, but still find it worth-while, let me know (email posted at my site) and I'll check with a colleague who runs x64 to see if they're willing to give it a crack--probably for a fee of some sort, since they're so busy.
Jeff Mowry
www.industrialdesignhaus.com
Reason trumps all. And awe trumps reason.
RE: 280+ MB slddrw file
When you say, "it started growing exponentially" did you mean whenever you added a view or sheet?
Do you have any large feature (or sketch) patterns in the model?
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: 280+ MB slddrw file
For example, I had an assembly that was ridiculously slow to open, then after checking the statistics, I knew the quantity of some of the parts were to high. On a linear pattern of a part, I had 2 directions. I forgot to pick the "Pattern seed only" for the 2nd direction, which made the assembly huge.
Look in the FAQ for rules of thumb for parts and assemblies. Also make a copy of the drawing using "Save As", because that tends to shrink a file down some.
Flores
SW06 SP4.1
RE: 280+ MB slddrw file
smcadman:
winxp pro SP 2
pentium 3.4GHz dual
2 GB RAM
virtual memory 4095 MB
Assembly stats look reasonable. 207 total components, 100 unique parts. 14 sub assemblies. I have gone through my feature tree multiple times to make sure everything looks ok. Believe me, I wish I could go back in time and spend the 30 seconds it would have taken to do a "Save as" if i knew the grief it would have saved.
RE: 280+ MB slddrw file
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: 280+ MB slddrw file
RE: 280+ MB slddrw file
RE: 280+ MB slddrw file
Chris
Systems Analyst, I.S.
SolidWorks 06 4.1/PDMWorks 06
AutoCAD 06
ctopher's home (updated 06-21-05)
RE: 280+ MB slddrw file
Regards,
Scott Baugh, CSWP
www.scottjbaugh.com
FAQ731-376
RE: 280+ MB slddrw file
I guess I was hoping to find a completely different angle to attack this from. For instance some way to split the pages up from outside of solidworks or maybe delete a page or two from outside of solidworks. Or maybe a way to do a "save as" without actually running solidworks.........
Nothing more than wishful thinking I am sure.
RE: 280+ MB slddrw file
http
I use it and havent had any issues yet, it could drastically reduce your file size.
SW 2006 SP4.0
Dell Inc. Precision WorkStation 670
2048 Megabytes Installed Memory
NVIDIA Quadro FX 1400 [Display adapter]
Windows 2000 SP5
RE: 280+ MB slddrw file
RE: 280+ MB slddrw file
Try moving the assembly file to a different directory so that SW can not find it when it goes to open the drawing. It will likely complain a lot, but you might be able to get in delete a couple of sheets and do a save as. Then exit SW, move the assembly file back and try opening the copy.
Eric
RE: 280+ MB slddrw file
System Options > Drawings > uncheck "Allow auto-update when opening drawings"
System Options > Assemblies > check "Suspend automatic rebuild"
System Options > Performance > check "No preview during open (faster)"
Ctrl+alt+delete > Task Manager > Performance tab. For the CPU Usage History, are there 2 CPU graphs or 1? If there is 1, hyperthreading is disabled. If there are 2, hyperthreading is enabled. Try switching 1 mode to the other and see if that helps.
After restarting your computer, hit F2 (on mine anyway) repeatedly before the your log-on screen shows up. A screen should pop up that has your settings on it. Find the setting that says something like "Hyperthreading Technology" "Enable".
Also try EEnd's recomendation
Flores
SW06 SP4.1
RE: 280+ MB slddrw file
RE: 280+ MB slddrw file
RE: 280+ MB slddrw file