showing material to be removed
showing material to be removed
(OP)
I had the question posed to me how to show, on a drawing, the material to be removed. For example let's say you start w/ a rec. bar stock 12" long. Then you cut that down to 8". How do you do a drawing and show the 8" in a solid line type yet show the 4" that was removed in phantom or someother linetype. I know you could just draw the lines into the drawing to show it but I was curious if that could be done in the model somehow. I thought a split line might do it but I can't change the linetype after the splitline.
SW 2006 SP3.0
SW 2006 SP3.0






RE: showing material to be removed
Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 06
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716
RE: showing material to be removed
Best Regards,
Heckler
Sr. Mechanical Engineer
SW2005 SP 5.0 & Pro/E 2001
Dell Precision 370
P4 3.6 GHz, 1GB RAM
XP Pro SP2.0
NVIDIA Quadro FX 1400
o
_`\(,_
(_)/ (_)
Never argue with an idiot. They'll bring you down to their level and beat you with experience every time.
RE: showing material to be removed
Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 06
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716
RE: showing material to be removed
mncad
RE: showing material to be removed
No, you can't do it in SW. The reason, not standard practice.
Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 06
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716
RE: showing material to be removed
This will almost achieve what you are looking to do. You may have some issue with the linetype of some of the hidden lines, but you may be able to change those individual edges into solid.
-Shaggy
RE: showing material to be removed
1. Create the part model to finished size.
2. Create a configuration of the part (in our case we call it a lathe or mill configuration)
3. On the new configuration, use the "Move Face" feature (found on the "mold tools" tool bar)
4. Save the configuration
5. For the drawing, Sheet 1 is the finished size, sheet 2 (or whatever you choose to name it) is the configuration with the added material. Or optionally you could create a view of the secondary configuration on drawing sheet 1.
I agree with mncad and his rant by the way.
Hope this helps.
Brian
SW2006 sp3.4
RE: showing material to be removed
Then use a drawing sheet for each configuration and you have a step-by-step guide to building the part the way you want.
PS. Be very sure to build the model the exact same way you want your part build!
Stefan Hamminga
EngIT Solutions
CSWP/Mechanical designer/AI student
RE: showing material to be removed
I'm going for a walk...
Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 06
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716
RE: showing material to be removed
OK, rant over. Here is how to do it. It's a bit roundabout, but it works.
1. Model your part with two configurations - one as raw material and one as the finished part.
2. Insert the model into a new assembly. Make two configs of it, each one referencing a different configuration of the part model.
3. Make your drawing from this assembly. Each view should reference the assembly configuration referencing the finished part.
4. Add alternate positions referencing the raw material configuration on any view for which you want to show raw material.
Note that this does add all the limitations of alternate position views (no cropping, no broken-out sections, etc).
-Josh
RE: showing material to be removed
"We have a power supply we buy which works electrically, but doesn't fit our assembly. So we remove the mounting plate and drill some new holes and trim the size. It isn't rectangular, so we cut off .85" from one side and remove a 1" x .75" tab on the adjacent side. Then we add a 4-hole pattern for mounting and cut a few notches on the side. How do we show the material we removed..."
And the responses would be:
"That's too complicated. We need a picture"
"Why don't you buy one that fits?"
"Have you already done a search of the site? I think a similar problem was discussed here in 1998. Do your homework."
RE: showing material to be removed
Best Regards,
Heckler
Sr. Mechanical Engineer
SW2005 SP 5.0 & Pro/E 2001
Dell Precision 370
P4 3.6 GHz, 1GB RAM
XP Pro SP2.0
NVIDIA Quadro FX 1400
o
_`\(,_
(_)/ (_)
Never argue with an idiot. They'll bring you down to their level and beat you with experience every time.
RE: showing material to be removed
1) Create the model of the finished length part.
2) Add a sketch (to the model) representing the removed material. The linetype can be set in the sketch and the sketch can be set to Hide if necessary.
3) In the drawing view, make sure the sketch is set to Show.
This way the "removed material" information always stays with the model.
TFIF tomorrow.
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: showing material to be removed
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: showing material to be removed
I still hold to my opinion. Show the dwg as the final product. List the make from material in the BOM or a note. If the make from material/part is a unique shape and the finished part is unique to the M/F and is oriented as such, then it is OK to show the relation in a view. I would draw a sketch outline in the part's dwg view. The sketch can be dimensioned in the view to the part to make it constrained and then the dim's hidden.
Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 06
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716
RE: showing material to be removed
1) Show the sketch
2) Select the sketch lines and do a convert entities.
3) Hide the sketch/all sketches.
4) Change your Converted Entity lines to construction lines, or to some other line type if needed.
Ken
RE: showing material to be removed
Pete
RE: showing material to be removed
Thanks for all the input and glad I could open a can a worms for you all.
RE: showing material to be removed
Create a multibody part. The "removed material" can be modelled not "merged". Then in the drawing simply change the linetype to suit.
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: showing material to be removed
keep in mind this is an engineering forum and unless you are new here, you can expect others to correct you if you are asking to do something that typically shouldn't be done (typically the newbies to SW from AutoCAD). If this was simply a 12" flat-bar being sheared down to 8", I would show the finished part. The shop router/traveler should be the document that dictates the use of the 12" stock for that project.
Interestingly, the one who "rants" is the one who got a star, not the ones who supplied an answer to the original question.
Flores
SW06 SP3.0
RE: showing material to be removed
I did give a star to "the one who rants" because all I was looking for was could it be done not necessarily if it was right or wrong.
If your boss tells you to do a drawing but it's not standard are you not going to do it? All you can do is tell him it's not starndard and then give him what he want's.
Thank you all again. Lots of different ways to skin a cat.
RE: showing material to be removed
Chris
Systems Analyst, I.S.
SolidWorks/PDMWorks 05
AutoCAD 06
ctopher's home site (updated 06-21-05)
FAQ559-1100
FAQ559-716
RE: showing material to be removed
If you ask me...I'd just give a print of the stock if they really needed it and show them a simulation of the tooling in a CAM package.
RFUS
RE: showing material to be removed
I just tried it in SW2006 SP3.1 and it works. I don't think it's more work then other methods shown above.
RE: showing material to be removed
-b