Solidworks Custom Properties in Templates
Solidworks Custom Properties in Templates
(OP)
I am trying to make templates in SolidWorks 2005 and I figured out how to set properties in a part/assembly but I want to use those properties in a drawing template. Can someone help me out?
Also is it possible to meke it so when you open the File->Properties Menu all the properties show up. So the person setting the properties for the first time doesn't have to click the pull down, press tab THEN enter a value for each property? So they can just click where they want to enter a value, enter it and click ok.
Please help, I've been racking my brain for the last few weeks at work trying to get this simple little thing to work.
Thanks,
Jr-
Also is it possible to meke it so when you open the File->Properties Menu all the properties show up. So the person setting the properties for the first time doesn't have to click the pull down, press tab THEN enter a value for each property? So they can just click where they want to enter a value, enter it and click ok.
Please help, I've been racking my brain for the last few weeks at work trying to get this simple little thing to work.
Thanks,
Jr-






RE: Solidworks Custom Properties in Templates
Take your mouse and place it over the
Best Regards,
Heckler
Sr. Mechanical Engineer
SW2005 SP 5.0 & Pro/E 2001
Dell Precision 370
P4 3.6 GHz, 1GB RAM
XP Pro SP2.0
NIVIDA Quadro FX 1400
o
_`\(,_
(_)/ (_)
"Coming together is a beginning, staying together is progress, and working together is success." - Henry Ford
RE: Solidworks Custom Properties in Templates
link, notes to properties
customize, drawing sheet formats
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: Solidworks Custom Properties in Templates
RE: Solidworks Custom Properties in Templates
Does the poster of that fix remember?
RE: Solidworks Custom Properties in Templates
thread559-105113
thread559-559-139990
Flores
SW06 SP2.0
RE: Solidworks Custom Properties in Templates
Part "A" has property named "Prop1", value = Test Property
Drawing (or Template) "B" has property named "Prop1", value $PRP:"Prop1" (case sensitive, include quotes)
Put Part "A" into Drawing "B", regenerate, and look at properties in Drawing "B".
p.s. There are veteran forum members here who also don't always find what they are looking for using Search.
http://www.EsoxRepublic.com-SolidWorks API VB programming help
RE: Solidworks Custom Properties in Templates
The drawing template, does not normally contain the same properties as the part or assy. The sheet format usually has notes which are linked to generic properties, & when a parts view is placed on it, those generic properties are replaced with the actual parts property.
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: Solidworks Custom Properties in Templates
I set the "part" prop1 value to "something", the "template" property prop1 value to "$PRP:"prop1" and then i try and link the text i put in to the property but it crashes. What am i doing wrong?
RE: Solidworks Custom Properties in Templates
Regards,
Scott Baugh, CSWP
www.scottjbaugh.com
FAQ731-376
RE: Solidworks Custom Properties in Templates
CorBlimeyLimey said:
part/assy model
property (prop1) value = Anything
drawing template
property (prop1) value = $PRP"prop1"
Is that correct?
If I just use $PRP"prop1" in the drawing as the text it links it to a property set in the drawing under File -> Properties. This kind of works but like I said before I want to make a template to link to the model properties. Please, someone help... I can't find ANYthing online, in tutorials here or anywhere.
Thanks,
Jr-
RE: Solidworks Custom Properties in Templates
OK, step by step:-
1) Open a new drawing document.
2) Insert a view of a part.
3) RMB click anywhere in the document, but NOT in the parts view & select Edit Sheet Format.
4) Click on the Note icon in the Annotations toolbar (or Insert > Annotations > Note) & place it on the sheet. Do not type anything.
5) Click the Link to property icon in the Note Manager. It's the one with the hand & chain links.
6) In the new options box which opens, select Model in view specified in sheet properties.
7) Click the chevron to display all the available properties for the part.
8) Select the custom property you want to link to the note & click OK.
9) Click the green check mark or hit the Enter key. The note should now display the property from the part.
10) RMB click anywhere in the sheet & select Edit Sheet
11) Click File > Save Sheet Format, browse to where the Tools > Options > File Locations > Sheet Formats points to, type a file name & click Save.
12) Close the document you have open without saving.
Now when you open a new drawing document, you will be able to select the Sheet Format you just created, & when you insert a part view onto it, the property will automagically be populated.
Helpful SW websites FAQ559-520
How to get answers to your SW questions FAQ559-1091
RE: Solidworks Custom Properties in Templates
htt
ht
htt