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Chamfer or Fillet a portion of an edge

Chamfer or Fillet a portion of an edge

Chamfer or Fillet a portion of an edge

(OP)
Is there a way to abruptly terminate a chamfer or fillet at some position along an edge? I have been splitting the part into two bodies chamfer the edge of one of them, and then combine the bodies back together. This works, but seems to be the hard way...and in some cases I can't split the part because previous features fail.

tom..

RE: Chamfer or Fillet a portion of an edge

I usually insert a Plane at teh start point of the feature, then cut-extrude a chamfer or fillet the desired distance to get it to terminate.

"I think there is a world market for maybe five computers."
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Have you read FAQ731-376 to make the best use of Eng-Tips Forums?

RE: Chamfer or Fillet a portion of an edge

Post a pic if you can.
All, uncheck tangent propogation and select the edges manually.

Jason

UG NX2.02.2 on Win2000 SP3
SolidWorks 2005 SP5.0 on WinXP SP2
SolidWorks 2006 SP1.0 on WinXP SP2

RE: Chamfer or Fillet a portion of an edge

(OP)

http://img7.imageshack.us/img7/2729/chamfer7ml.th.jpg[/IMG][/URL]

Click the link above, Here is a simple pic of a chamfer along an edge but stops short at some point. I did this by splitting the body in two, and then chamfering one of them then combining them back together. I was hoping for an easier way.

Thanks MadMango, I have done what you suggest also

tom..

RE: Chamfer or Fillet a portion of an edge

Draw a sketch for your chamfer then do an extruded cut

RE: Chamfer or Fillet a portion of an edge

For that part, I would just create the chamfer as an extrude cut with the depth needed.

You also do a split line on the face to get two edges, then chamfer the edge.

Jason

UG NX2.02.2 on Win2000 SP3
SolidWorks 2005 SP5.0 on WinXP SP2
SolidWorks 2006 SP1.0 on WinXP SP2

RE: Chamfer or Fillet a portion of an edge

Gildashard ... That was the first thing I tried (split line/two edge) & it did not work??? The fillet continued past the split. Did I miss something?


Helpful SW websites  FAQ559-520
How to get answers to your SW questions  FAQ559-1091

RE: Chamfer or Fillet a portion of an edge

(OP)
I have tried many of the suggestions posted here and most work depending on the feature to be chamfered. I appreciate all the feedback, but I was just hoping there was some hidden functionality that I wasn't aware of like dragging the highighted line in the chamfer preview or something similar to Edge Flange dragging to change its width. It would be neet if SW added a optional start position and end position in the fillet and chamfer control dialog box.

tom..

RE: Chamfer or Fillet a portion of an edge

Submit an Enhancement Request to SW.


Helpful SW websites  FAQ559-520
How to get answers to your SW questions  FAQ559-1091

RE: Chamfer or Fillet a portion of an edge

As you know, there is more than one way to skin a cat.  Though you want a one-button solution, the easiest way would have been to draw a triangle and use an extruded-cut.  It's like taking the long way around trying to find a shortcut.  

Flores
SW06 SP1.0

RE: Chamfer or Fillet a portion of an edge

Also, if you would like a break out radius/cutter radius at the ending, you can sweep a triangle along a path... I do this probably once every 3 months or so, and it actually comes out looking nice and you can even dimension the runout radius.

RE: Chamfer or Fillet a portion of an edge

I've run into the same problem, and came up with the following solution:

1) create a plane at opposite angle from chamfer angle along the edge to be chamfered and from adjacent plane (in the case of the example I used the front plane and created a 135-deg plane for a 45-degree chamfer)

2) cut-extrude - sketch a rectangle, specify length of chamfer, add radius at end(s) of cut.

[URL=http://imageshack.us][IMG]http://img158.imageshack.us/img158/2276/chamfersketchsample1qx.jpg[/IMG][/URL]

[URL=http://imageshack.us][IMG]http://img204.imageshack.us/img204/5439/chamfersample7ub.jpg[/IMG][/URL]

RE: Chamfer or Fillet a portion of an edge

Oops...forgot to mention, the cut-extrude feature is from the sketch plane, through-all, in both directions.

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