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ddeck (Mechanical) (OP)
10 Nov 05 14:58
Is there a way in Solid Edge Draft to make the hole callout automatically grab how many holes of the same type?

"2X DIA .125 THRU"

In assembly it can pattern to holes that are created within the same step or feature, so draft should be able to count how many holes there are.
fredericmenage (Mechanical)
10 Nov 05 15:38
Hi,

I think the only way is to make a hole table : you can add a 'count' column when you list by type/list each type.

Fred
fwc (Mechanical)
11 Nov 05 8:58
You could Expose the pattern quantity in the Variable Table from assembly/part environment. You can then retrieve this from Callout command.
vriyg (Aeronautics)
11 Nov 05 10:54
I don't see how you could use the expose variable feature in this case. A hole diameter would use a dimension, not a callout to indicate its size and using a dimension, I don't think you have access in prefix to retrieve an exposed variable. Also, the variables are two folds, one for number of holes in X, one for the Y qty. Is there a way to combine both?
PellaKen (Mechanical)
12 Nov 05 1:20
Vriyg,
    The Callout command has all the necessary annotation tools to properly callout holes made with the Hole command. You can build it by hand or use the Hole Callout annotation which can be preconfigured to use specific annotation dependent on the hole type selected(simple, threaded, counterbore, etc...).  You can then also add a Property Text item that uses the exposed variable for the count, but the only way a count would be available as a variable would be if a hole was patterned.  If the hole was placed multiple times during a single hole command instance, then there is no count.

Ken
fwc (Mechanical)
16 Nov 05 7:13

Quote (Vriyg):

Also, the variables are two folds, one for number of holes in X, one for the Y qty. Is there a way to combine both?

You could create a variable with formula X*Y and Expose it.

vriyg (Aeronautics)
16 Nov 05 11:13
Works good but how do you limit the decimal places?
I want to see: "4X DIA .250" not "4.000X DIA .250".
fwc (Mechanical)
16 Nov 05 21:03
I believe the unit type for the variable is scalar. You can change its decimal places in Advance Units under File Properties.

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