×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Machining accuracy

Machining accuracy

Machining accuracy

(OP)
Hello,
  I recently had a tight toleranced dwg where I had called out  a +/- 0.00025 on distance between two holes and the same tolerance on the height of the block.
  Now the machines I know (like typical bridgeport and other conventional mills) can do tolerances like +/- 0.0005 or lesser, however am not sure about the precision below half a thousand.
  I have a company who claims they can do this, but am not sure if they are going to do it exactly.
  I have this question
Are there machines that can do +/- quarter of a thousand ? (exactly without rounding off to .0003 or .0002?)
If so can you give me some names/websites where I can read more about them?
Thanks

RE: Machining accuracy

Sorry I am metric, this is ±0.006 mm right? Most surface grinder can do this flat, and good machinist can surface grind to height in this tolerance if he has correct measurement equipment to know when to stop.

Hole position is more difficult, good accurate VMC (Bostomatic BD12) can position to 1/3 this but may tool doesn't start exactly right. Look also at sink EDM or jig bore (Moore tool still makes jig borer IIRC.)

How many parts you make? Dedicated multi drill head can do this but costs too much unless you are making autos.

RE: Machining accuracy

Any good Jig Boring machine can do this. Just search for Jig Boring, Jig Borers etc.

RE: Machining accuracy

Hi,

Most CNC machines have a tolerance of +/- .003.  Is this part you making going to be for huge production runs or a one of?  I would try not to use that kind of tolerance on huge production runs.  If this was a mold to make other parts but this is still hard to achieve little lone to measure with your average hand held calibers, maybe you should request a CofC (Certificate of Compliance) with this part.

Tofflemire

RE: Machining accuracy

Jig grinding (is that what you guys mean by jig borer?) can easily achive those sorts of tolerances. our die details are commonly drawn around .0001" and need to be with in .0002" of nominal. (roughly)

RE: Machining accuracy

A traditional jig borer resembles a Bridgeport, but is sturdier, and position of the spindle relative to the table is set with gage blocks and indicators rather than calibrated screws.  The spindle rotates and translates a single point boring tool to make or enlarge a hole. { The jig borer operator appeared to be on the hourly payroll, but always drove a really nice car and golfed, with the Chairman.  It may have been a law. )

A traditional jig grinder is similar, but the spindle orbits and translates a high speed grinding spindle to enlarge an existing hole.  This was also commonly done with an attachment to the jig borer.

The jig borer has been made obsolete by super- precise CNC mills, which can run autonomously.  I get the impression that jig grinders are still operated manually.  I don't know if they still use gage blocks, or super- precise DROs.

Mike Halloran
Pembroke Pines, FL, USA

RE: Machining accuracy

mike- our grind shop uses both gage blocks and really precise DRO's. Of course our shop still runs theirs manually, I have a feeling that newwer ones have gotten microprocessor control and with feedback loops are even more precise than teh old school ones.

(Although really precise/accurate old school equipment is awesome. We had an XRD machine (Scintag?) in college that had a tube powersupply and a chart recorder. The staffperson that ran the X-ray labs said it was better than the newer Siemens machine by far.) Teh goniometer gears were springloaded I think to reduce lash.

RE: Machining accuracy

The height is no problem; provided it is flat, not contoured, just look at the limits on slip gauges.

The distance between the holes is more problematic, you do not mention the distance, if it is say .500” okay if it is 20 feet you will have your work cut out.

You stand next to no chance in doing it on a Bridgeport or any other similar turret mill, get your self a nice “tenths” clock bore a hole undo the locks move away in two axis go back to zero do the locks up, is it within 0.0002”? No I thought not.

Even CNC or jig borers that have had a “hard life” will struggle with this. To have any degree of certainty I would say you need someone who has at the least a temperature controlled shop if not an environmentally controlled shop.

Ask to see the calibration records for the machines and there inspection equipment, if they don’t have them the chances are you will get some paper weights to put on your desk.

RE: Machining accuracy

Devil's Advocate: if the coefficient of thermal expansion of the work and the machine are matched then temperature control is less important?

Cheers

Greg Locock

Please see FAQ731-376 for tips on how to make the best use of Eng-Tips.

RE: Machining accuracy

The machines are not made of a single material.

... and ...

At micron tolerances, beyond the temperature controlled room, you have to do anal stuff like let the spindle run for a couple of hours so its temperature distribution, and dimensions, will stabilize.

Mike Halloran
Pembroke Pines, FL, USA

RE: Machining accuracy

I've never had to do that with the new CNC stuff. But in the old days we used indicators and rods called standards. That was our form of digital read out.
And yeah has to be temp stablized. So why is it so important to have that particular tolerance? It must be a gage? Or for micro electronics?

RE: Machining accuracy

What is the material?

What is the size of the part to be machined?

What size are the holes and precision required on same, assuming C/L dimensions?

RE: Machining accuracy

As I'm sure you already know, the more zeroes in the number the more expensive it is (exponentially so)!

The real question to ask is: Why do I think I need that tight tolerance? One which dimensions?

Truck

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources