×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Impose thermal evolution from another analysis

Impose thermal evolution from another analysis

Impose thermal evolution from another analysis

(OP)
Hello,

I would like to impose the thermal history from all the nodes of my mesh that result from another (non Abaqus) analysis. In other words, i've got a database with the temperature values of all the nodes at each time increments and i would loke to use it in order to run a mechanical analysis.
How can I do that?

Denis

RE: Impose thermal evolution from another analysis

It would have been easier just to run the thermal analysis in Abaqus, however, if you can cut and paste from the database then just use *temperature followed by node, temperature where the node, temperature values will be from the database.

corus

RE: Impose thermal evolution from another analysis

(OP)
It is a magneto-thermal calculations that i could not run with Abaqus unfortunately! But by using the option *TEMPERATURE and then by fixing the temeprature of each node, how can i do that for every time increment?

*TEMPERATURE, INC=1
1, 25
2, 25
...
*TEMPERATURE, INC=2
1,25.5
2,25.1
...

????

RE: Impose thermal evolution from another analysis

Define a step for each time increment

corus

RE: Impose thermal evolution from another analysis

dlassance,

Have you considered the UTEMP user subroutine?

SUBROUTINE UTEMP(TEMP,MSECPT,KSTEP,KINC,TIME,NODE,COORDS)

You know the current ABAQUS time, so perhaps you can interpolate results from your database time to ABAQUS time.

MRG

RE: Impose thermal evolution from another analysis

(OP)
Yes, it's probably what i will do while defining the temperature of each node at each time increment. The abaqus support told me that:

"It is actually not unworkable, you need to write a miniscule database which reads the time into an array
and loads the temperatures on demand or on startup. If the mesh is the same this is rather trivial."

but, i don't understand what they mean and how to realize that...

Denis

RE: Impose thermal evolution from another analysis

dlassance,

Let's assume the mesh is the same. You don't need to interpolate the coordinates from the thermal analysis to the ABAQUS mesh. However, you need to interpolate the temperature at a given time.

In the ABAQUS analysis you need:
*TEMPERATURE, USER
NALL

where NALL is the node set of all nodes in the mesh.

You need to write the subroutine UTEMP (see bare bones below) and submit the job accordingly:

abaqus j=job1 user=utemp.f

Lets say that UTEMP is called at node 101 at an ABAQUS time of t. You read in your database temperatures for node 101 at the two time increments from your thermal analysis that span that time. Say they are times t1 and t2, with corresponding temperature T1 and T2. It is now a simple matter to interpolate to find the nodal temperature at time t:

T = T1 + (t-t1)*(T2-T1)/(t2-t1)   (I hope!)

Note that it would be sensible to set your ABAQUS step times to correspond to the times in your thermal analysis.

So, in each call to UTEMP you would:
* if not already open, open the file containing the thermal analysis results,
* loop through the file to search for the temperatures at the particular NODE that span the current ABAQUS step time or total time (stored in the array TIME),
* interpolate to find the temperature at that node at the current time,
* set the variable TEMP and return from the subroutine.

I hope this helps.

MRG

      SUBROUTINE UTEMP(TEMP,MSECPT,KSTEP,KINC,TIME,NODE,COORDS)
C
      INCLUDE 'ABA_PARAM.INC'
C
      DIMENSION TEMP(MSECPT), TIME(2), COORDS(3)
C

      user coding to define TEMP

      RETURN
      END

RE: Impose thermal evolution from another analysis

It may be better if you could convert the database into a .fil file then Abaqus could simply read in the values and interpolate at the same time. I'm not sure how the binary .fil file is formatted, however.

corus

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources