graphics in PROE
graphics in PROE
(OP)
I have some graphics that I would like to put into PROE. It is a JPEG file and was wondering how I can make this work in PROE? Does anyone have any suggestions? It would be nice if I could easily change the JPEg to dxf.





RE: graphics in PROE
See http://www
Now for the problem:
Pro/E does not like these DXF files one bit in a 3D model. They work just fine in drawing mode (i.e. Title Block logos, etc). But as soon as you try to import these files into a sketch, Intent Manager warns you that there are way too many entities to be dimensioned. If you do not heed this warning, Pro/E gets really mad at you and freezes your computer, or places enough dimensions on the screen to make you dizzy. Since the conversion is an approximation of the raster, its bound to create a lot of unfriendly geometry.
If it is to be ported to 3D (i.e. an embossed logo), your 2 best options are to try and make the logo as a sketch yourself (I know its crazy but it can be done), or try to track down the source of the JPG (i.e. graphic designer) and see if they have an original vector format (*.ai, *.eps) and ask them to at least export a DXF from Illustrator or whatever they use. You will still have a dimensioning nightmare but it will be a lot easier to manage than one that has been converted from a raster file.
RE: graphics in PROE
RE: graphics in PROE
If you are using WF2 (and have ISDX), you can use the Trace Sketch tool to place the JPEG on a datum plane. Position it appropriately, then select the plane as the active style plane.
Create planar curves which trace your logo. This is where you have to be careful: The endpoint of every new curve must be snapped to the very end of the previous curve. You can either snap it to the vertex directly, or snap it to the curve and drag it all the way to the end (btw: SHIFT snaps the point). If you don't do this, you will not be able to create a solid later on.
So now you have a style feature with a series of curves which have traced your JPG. Hide the JPG from the Trace sketch menu. Finish the style feature and start a new sketch on the same plane that you used for the style.
Choose the "use edge" tool and choose "Loop" as your option. Select the style curve and it should select all adjacent edges.
If all went well when you created the style, you should be able to select the sketch now, press extrude, and get a solid right away. If you see just a surface, the section isn't closed. If you see a surface that does some really wierd stuff (i.e, it doesn't know what side is what, when you see it, you'll know what I mean), it means that the start point of a curve is not at the end point of its previous curve.
This method allows you to also dynamically manipulate the shape in ISDX without all those annoying dimensions in sketcher. Creating it as a surface quilt with capped ends will allow you to manipulate it even further using the warp tool.
RE: graphics in PROE
"The start point of every new curve must be snapped..."
RE: graphics in PROE
Click on
Insert
Object
Create from file
RE: graphics in PROE
RE: graphics in PROE
You will still have a mess to import into Sketcher, but not as bad of a mess.
RE: graphics in PROE
RE: graphics in PROE
Not sure what happened to my post this morning ...I must of just previewed it not sent it.
Whole lot of info over at McadCental.
I have access to a cam program that will dxf it out..but wouldn't know how you could email me it