×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Collapse load for an in-plane loaded panel
2

Collapse load for an in-plane loaded panel

Collapse load for an in-plane loaded panel

(OP)
Due to symmetry I have modelled only a quarter of a sandwich panel, loaded in plane in one direction. To apply the load I have used a prescribed displacement. When I then want to find the corresponding load, I have summarised the reaction forces in every node on the loaded edge. However, because I have only modelled a quarter of the panel, to achieve the buckling load for the entire panel, I should double the achieved load, shouldn't I?  

RE: Collapse load for an in-plane loaded panel

if you modelled the unloaded edge as an axis of symmetry, then the total load applied to the panel (to get the results you have) is double the model applied load.

but why would your arbitary(?) applied load be the buckling load of the panel ?

RE: Collapse load for an in-plane loaded panel

tuss - the minimum buckling mode may not be symmetric wrt the centerlines of the panel - think of a buckling mode that has 2 half waves in the length or width of the panel  - in this case the mode shape displacement is not symmetric.  Therefore, you must model the entire plate if you are doing a buckling analysis.

RE: Collapse load for an in-plane loaded panel

SWComposites

wouldn't that be the 2nd buckling mode, and so less critical than the 1st (assuming that the middle of the panel can deflect) ?

i'm more curious that tuss thinks he has found the buckling load in the first place ??

RE: Collapse load for an in-plane loaded panel

This is how you do it:

a) Unless you are talking high speed loads, the first, half wavelength, mode is the only one two consider.

b) Use one of the combined mode shape/buckling proceedures in your FE code to calculate the load for you then look at the text output file to see what it calculates.

c) Run a modal analysis, deform your original mesh using (probably, but not definitely) the first mode and scale the max deformation to be the max skin waviness. Then apply an overly large load in a NONLINEAR static analysis and see what load fraction the analysis bombs out at - this will be the buckling load.

d) Manually put a small dimple in your mesh, again within surface waviness limits, and do a nonlinear analysis as in c), the load will be very similar to that in c)

Regards,

gwolf.

RE: Collapse load for an in-plane loaded panel

a) the first buckling mode has only one halfwave length for a ~square plate.  For a plate with a 2:1 aspect ratio the first mode has 2 half waves in the long direction, etc.

b) I'm assuming that tuss ran an eigenvalue buckling analysis; in this case you take the eigenvalue times the applied loads to get the theoretical buckling load.

RE: Collapse load for an in-plane loaded panel

(OP)
Thank you for your answers!
However, I accidently wrote that I wanted the buckling load for the panel which was not correct, I just wanted the applied load corresponding to the prescribed displacement. The buckling load (for the first eigenmode) I achieved from a buckling analysis by multiplying the load with the eigenvalue. The load I'm now interested in is in the nonlinear postbuckling analysis. Then I just got confused concerning if I should double the load to get the corresponding load for the entire panel, which I intuitively thought.

RE: Collapse load for an in-plane loaded panel

tuss,

you've modelled a 1/4 panel and applied an edge displacement, and you're trying to analyze the full-size panel for post-buckling behaviour ... DON'T.

the (presumably shear) buckling behaviour of the 1/4 panel will be very different to the behaviour of the full panel.

in the linear range, i think the load on the full size panel is 1x the 1/4 panel ... 2x from the width is obvious, but i think you have a 0.5x from the length, consider strain in the length direction, the full size panel will have 1/2 the strain as the 1/4 panel ('cause it'll have twice the length).

for the full size panel you better off modelling the entire panel

good luck

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources