Sweeps on 3D sketches
Sweeps on 3D sketches
(OP)
Before I put my fist through my monitor... I know this can be done, as I have done it in the past, but I'm apparently not remembering the special "trick" required.
I have created a 3D sketch, starting at the origin. I then create another sketch for my profile (a circle), again using a plane through the origin. I then hit the sweep function, pick the circle for the profile but every time I try to pick the 3D sketch as the path, nothing happens...
Any ideas?
Thanks...
I have created a 3D sketch, starting at the origin. I then create another sketch for my profile (a circle), again using a plane through the origin. I then hit the sweep function, pick the circle for the profile but every time I try to pick the 3D sketch as the path, nothing happens...
Any ideas?
Thanks...






RE: Sweeps on 3D sketches
Check your filters to be sure. Perhaps try filtering for curves only. That, and try picking the 3D sketch from the feature tree.
http://www.EsoxRepublic.com-SolidWorks API VB programming help
RE: Sweeps on 3D sketches
I have also tried to pick the 3D sketch from the tree as well... several times...
No filters help...
Thanks for the suggestions though...
RE: Sweeps on 3D sketches
Try pre-selecting both the profile & the path before activating the Sweep feature.
Making the best use of this Forum. FAQ559-716
How to get answers to your SW questions. FAQ559-1091
Helpful SW websites every user should be aware of. FAQ559-520
RE: Sweeps on 3D sketches
Chris
Sr. Mechanical Designer, CAD
SolidWorks 05 SP2.0 / PDMWorks 05
ctopher's home site
FAQ371-376
FAQ559-1100
FAQ559-1091
FAQ559-716
RE: Sweeps on 3D sketches
Regards,
Scott Baugh, CSWP
3DVision Technologies
www.3dvisiontech.com
www.scottjbaugh.com
FAQ731-376
FAQ559-716 - SW Fora Users
RE: Sweeps on 3D sketches
RE: Sweeps on 3D sketches
Regards,
Scott Baugh, CSWP
3DVision Technologies
www.3dvisiontech.com
www.scottjbaugh.com
FAQ731-376
FAQ559-716 - SW Fora Users
RE: Sweeps on 3D sketches
Chris
Sr. Mechanical Designer, CAD
SolidWorks 05 SP2.0 / PDMWorks 05
ctopher's home site
FAQ371-376
FAQ559-1100
FAQ559-1091
FAQ559-716
RE: Sweeps on 3D sketches
Not quite sure what this means though: "IS the 3D sketch actually in 3D space?"
How could it not be in 3D space?
RE: Sweeps on 3D sketches
http://www.scottjbaugh.com/Images/Spline.wmv
Regards,
Scott Baugh, CSWP
3DVision Technologies
www.3dvisiontech.com
www.scottjbaugh.com
FAQ731-376
FAQ559-716 - SW Fora Users
RE: Sweeps on 3D sketches
sounds simple, but went through it today with an associate.
¿)
To get the best from these forums read FAQ731-376 before posting
RE: Sweeps on 3D sketches
dsgnr1: I can't exit the sketch via a sweep, it will only allow me to exit via an extrusion... what does that say about my "3D sketch"?
RE: Sweeps on 3D sketches
The Profile & Path must be seperate sketches.
Both sketches must be exited from (using the sketch icon) before activating the Sweep.
The Path can be a 2D or 3D sketch ... even a 3D sketch with the path drawn on one plane (2D) will work.
The Paths start point does NOT have to be coincident to any point of the Profile. However, it does have to be coincident with the plane that the Profile is on.
[img=http://img102.exs.cx/img102/7276/sweep9rl.jpg]
Can you repost a (smaller) image showing your Feature Manager?
Making the best use of this Forum. FAQ559-716
How to get answers to your SW questions. FAQ559-1091
Helpful SW websites every user should be aware of. FAQ559-520
RE: Sweeps on 3D sketches
Sketches are speperate (why I had posted larger pics before). Planes are coincident.
If someone's really bored, they can look at the part here: http://www.meche.net/images/012965.SLDPRT
I'm just about to the point whee I'm going to do this with a bunch of seperate sketches...
RE: Sweeps on 3D sketches
Making the best use of this Forum. FAQ559-716
How to get answers to your SW questions. FAQ559-1091
Helpful SW websites every user should be aware of. FAQ559-520
RE: Sweeps on 3D sketches
I think that it is best to draw your path first then add a pierce relationship to the 3D sketch. It is much more stable than adding a coincident relationship.
Also I would try to add better contraints to your 3D sketch. There may have been something a little out of alignment causing the sketch to fail.
I hope this helps.
Best Regards,
Jon
Challenges are what makes life interesting; overcoming them is what makes life meaningful.
Solidworks 2005 SP2.0
RE: Sweeps on 3D sketches
Check sketch for feature is located under tools\Sketch tools\
Regards,
Scott Baugh, CSWP
3DVision Technologies
www.3dvisiontech.com
www.scottjbaugh.com
FAQ731-376
FAQ559-716 - SW Fora Users
RE: Sweeps on 3D sketches
Regards,
Scott Baugh, CSWP
3DVision Technologies
www.3dvisiontech.com
www.scottjbaugh.com
FAQ731-376
FAQ559-716 - SW Fora Users
RE: Sweeps on 3D sketches
OK then... somehow, as you've found out, the sketch was "corrupt" (or disjoint, as SW loves to put it). I have never used the "repair sketch" funcion, and don't do much 3D sketching like this at all, but I think I'll remember this one!
I tried to create a composite curve, and, as you said, it errored on me with "disjoint sketch". I did the "repair in the sketch tools, and it's working!
Woot!
Thanks a million guys, sorry this one was so much greif.
Scott
RE: Sweeps on 3D sketches
I just tried your file, but I edited the 3D Sketch, and I ran the Repair Sketch tool (Tools->Sketch Tools->Repair Sketch) on it, then tried the sweep and it worked. So something is definitly wrong with the sketch. If it's not to late, give this a try.
Good Luck
RE: Sweeps on 3D sketches
I tried making a composite curve of the 3D sketch, and I got an error message that the sketch was disjointed. Maybe some endpoints don't quite meet or you have a segment doubled-up.
What's with the micro-sized straight segment in the middle of your hairpin bends?
http://www.EsoxRepublic.com-SolidWorks API VB programming help
RE: Sweeps on 3D sketches
RE: Sweeps on 3D sketches