×
INTELLIGENT WORK FORUMS
FOR ENGINEERING PROFESSIONALS

Log In

Come Join Us!

Are you an
Engineering professional?
Join Eng-Tips Forums!
  • Talk With Other Members
  • Be Notified Of Responses
    To Your Posts
  • Keyword Search
  • One-Click Access To Your
    Favorite Forums
  • Automated Signatures
    On Your Posts
  • Best Of All, It's Free!
  • Students Click Here

*Eng-Tips's functionality depends on members receiving e-mail. By joining you are opting in to receive e-mail.

Posting Guidelines

Promoting, selling, recruiting, coursework and thesis posting is forbidden.

Students Click Here

Jobs

Indentation with two materials: convergence problems

Indentation with two materials: convergence problems

Indentation with two materials: convergence problems

(OP)
I want to model an indentation. The part wich is indented by a punch is made of two materials with different yield stress. I noted that when I use the values 376 and 200 MPa for Yield Stress everything is ok. But if I choose 376 and 110 MPa the job is aborted because of convergence problems. It happens in the final part of the job.
I think It has something to do with the difference between the values. Am I right?
Does anybody know how I can solve this?

Thanks in advance,

BRA

RE: Indentation with two materials: convergence problems

It depends on what is causing the loss of convergence. I assume that the increment size is being cut back because you're not achieving either force/moment or displacement convergence. Look at your .msg file and tell us what field variable is causing this. One of my tricks in this situation is to relax the convergence tolerances (I often find that the displacement tolerance is the culprit). Another trick is to restrict the maximum size of the increments to say no more than 5% of the step size. You might find that by doing this solution takes a different 'route' and the problem goes away.
MRG

http://www.analysis.demon.co.uk

RE: Indentation with two materials: convergence problems

(OP)
MRG,
 
 Thanks for your attention. I looked at my .msg file and  I think the error is because the displacement problems. The last increment reports this:
 
 THE MOMENT    EQUILIBRIUM EQUATIONS HAVE CONVERGED
 DISP. CORRECTION TOO LARGE COMPARED TO DISP. INCREMENT

 This message repeats during 5 interations and the job is aborted. I have started using abaqus few weeks ago and I'm using abaqus CAE. Could you tell me how can I relax the convergence tolerances?

 Thanks in advance,

 BRA


 

RE: Indentation with two materials: convergence problems

In abaqus manual 6.4 read " Getting started with abaqus standard/keywords version" In the section for non-linearity read the non-linear skew plate example. It explains how abaqus computes the force and displacement correction. From there you can change the displacement correction factors to get convergence. Channging these factors though might not produce accurate results though I think.
harry

RE: Indentation with two materials: convergence problems

Try this. It sets a more relaxed displacement tolerance of 10%, i.e. allows corrections to the displacements of 10% compared with the actual displacements.
*CONTROLS, PARAMETERS=FIELD, FIELD=DISPLACEMENT
** R_n^alpha C_n^alpha q_0^alpha q_n^aplha R_p^alpha eps^alpha
           ,   0.10   ,          ,          ,  
btw, does ABAQUS report nodes going in and out of contact? Also, try restricting the maximum size of the increment:
*STATIC
** init'l  time period  min.    max.
** time    of step      time    time
   0.01   ,  1.00  ,  1.0E-6 ,  0.05

MRG

http://www.analysis.demon.co.uk

RE: Indentation with two materials: convergence problems

If it is a dynamic problem then explicit would be easier but if it is just a static one like the classic indentation problems you will have to be careful when you do explicit, try it out with standard and see if it works. Sometimes I have found that if you change one tolerance the other might fail to converge. Just a thought and may not happen in your problem.
harry

Red Flag This Post

Please let us know here why this post is inappropriate. Reasons such as off-topic, duplicates, flames, illegal, vulgar, or students posting their homework.

Red Flag Submitted

Thank you for helping keep Eng-Tips Forums free from inappropriate posts.
The Eng-Tips staff will check this out and take appropriate action.

Reply To This Thread

Posting in the Eng-Tips forums is a member-only feature.

Click Here to join Eng-Tips and talk with other members!


Resources