Custom made title block
Custom made title block
(OP)
hi there,
big problem here...if you can help...
Does anyone knows how to convert Auto CAD made company's title blocks so that can be ussed in SolidWorks.
I was able to save Auto CAD title block as a drawing tamplate and thats all. When I start new drawing my custome made tamplates are visible.
Hard part is what to do, and how, so that my title block puls info from part or ass'y to fill up some fields automaticaly like Title, Drawn by, Designed by and drawing number...
thanks a lot,
lakewood
big problem here...if you can help...
Does anyone knows how to convert Auto CAD made company's title blocks so that can be ussed in SolidWorks.
I was able to save Auto CAD title block as a drawing tamplate and thats all. When I start new drawing my custome made tamplates are visible.
Hard part is what to do, and how, so that my title block puls info from part or ass'y to fill up some fields automaticaly like Title, Drawn by, Designed by and drawing number...
thanks a lot,
lakewood






RE: Custom made title block
e.g. - $PRPSHEET:"SW-Title"
There are some that are already given.
The best way I have found to do this is to build a test part with all your Custom properties you think your going to use in a drawing. Then place that file into your Template/Sheet format.
Edit the sheet format, add some new notes (Annotations). Click Link to property (middle icon in the property manager under Text Format). Pick "Model in view specified in sheet properties". Click the Down arrow. There it should list all Custom Properties you made at the part level.
Regards,
Scott Baugh, CSWP
http://www.3dvisiontech.com
http://www.scottjbaugh.com
If you are in the SW Forum Check out the FAQ section
To make the Best of Eng-Tips Forums FAQ731-376
RE: Custom made title block
RE: Custom made title block
Model- Designer, Design Date, Nomenclature, Material Finish
Drawing- Rev, Rev Date, everything else.
We did this to ensure users were forced to open and look at the model if there were design changes to the material, as most of our components are sheet metal, and thickness ranges can vary greatly based on gage and material type.
Ray Reynolds
"Computers in the future may weigh no more than 1.5 tons."
Popular Mechanics, forecasting the relentless march of science, 1949
Have you read FAQ731-376 to make the best use of Eng-Tips Forums?
RE: Custom made title block
Is it possible to get a copy of your template? I would like to set mine the same way. If you can't, no problem.
thanks
RE: Custom made title block
When you created your AutoCAD template way back when, did you put the title and part number in the AutoCAD title block using notes and text only? The other method AutoCAD has is to put the title and part number title block information in as attributes. If you did not use attributes then the information will not be automatically filled into the SolidWorks title block. That was our problem when we built our AutoCAD title block many years ago.
Bradley
RE: Custom made title block
I am sorry that I cannot send the template (company property) to you but I can tell you this. If you look at the new drawing you see nothing in the description or part number feilds. When you right click to edit the sheet you will see in blue lettering $PRPSHEET:{OurPrtNo} in the part number block, when a part is placed on the drawing template it gets this information from the design table column $PRP@OurPrtNo. If there is no $PRP@OurPrtNo in the design table of the model the text appears blank on the drawing. The $PRPSHEET represents the model specified in the sheet properties. You can specify which view the model is chosen from in the sheet properties dialog. This also works great for attaching notes to parts in assy drawings, you simply attach the note to the component and link it to the model to which the annotation is attached to show the property you desire (we use this for part numbers, our part numbers change often based on customer revision). The single biggest flaw I see in the whole system is an annotation cannot be linked to the properties of a sub assy.
RE: Custom made title block
Are you saying that you do not use properties in the SolidWorks template?
Bradley
RE: Custom made title block
RE: Custom made title block
Lakewood
RE: Custom made title block
Any chance for you to explanin it simpler - step by step so I could understand it better.
thanks,
lakewood
RE: Custom made title block
When you created your AutoCAD template, did you put the title and part number in the AutoCAD title block using notes and text only?
Bradley
RE: Custom made title block
The best way I have found to do this:
1) Build a test part with all your Custom properties you think your going to use in a drawing. lakewood - (test this with a single Custom Property)
2) Then place that file into your Drawing Template/Sheet format.
3) Edit the sheet format
4) Add some new notes (Annotations).
5) Click Link to property (middle icon in the property manager under Text Format).
6) Pick "Model in view specified in sheet properties".
7) Click the Down arrow. There it should list all Custom Properties you made at the part level.
Regards,
Scott Baugh, CSWP
http://www.3dvisiontech.com
http://www.scottjbaugh.com
If you are in the SW Forum Check out the FAQ section
To make the Best of Eng-Tips Forums FAQ731-376
RE: Custom made title block
RE: Custom made title block
The above method works either way.
Regards,
Scott Baugh, CSWP
http://www.3dvisiontech.com
http://www.scottjbaugh.com
If you are in the SW Forum Check out the FAQ section
To make the Best of Eng-Tips Forums FAQ731-376
RE: Custom made title block
Thanks,
lakewood
RE: Custom made title block
You can change line weight using the Line Thickness icon under the Line Format toolbar.
Regards,
Scott Baugh, CSWP
http://www.3dvisiontech.com
http://www.scottjbaugh.com
If you are in the SW Forum Check out the FAQ section
To make the Best of Eng-Tips Forums FAQ731-376